To Export a Drawing, Drawing Format, or Notebook to DXF or DWG
1. In a drawing, click > 
Save As > Save a Copy. The Save a Copy dialog box opens.
Save As > Save a Copy. The Save a Copy dialog box opens. | If you set the preferred_export_format configuration option to dxf or dwg, you can click > Save As >  Quick Export to directly export the drawing to these formats without changing the export settings. |
2. Select DXF (*.dxf) or DWG (*.dwg) in the Type box. The existing model name without the extension appears in the New file name box.
3. Accept the default name or type a new name for the model in the File name box.
4. Click OK. The Export Environment for DXF or the Export Environment for DWG dialog box opens.
5. Select a version for the file type.
6. Click the Entities tab to set other options:
◦ Splines as is or As Polylines
◦ Hatching as is or As Separated Entities
◦ Points as is or As Shapes
◦ Notes as Stroke All Characters, As Text, or as Stroke Special Characters
◦ Export multi-line note as MTEXT or as is
◦ UNICODE encoding to export the Unicode characters to DXF versions below 2007. This option is not available for DXF versions 2007 and above.
| | UNICODE encoding is not available on the Export Environment for DWG dialog box. |
◦ Text Alignment as Fit or As Is
7. Click the Sheets tab to set a sheet export option: Current sheet as model space, Current sheet as paper space, All sheets as paper space, or Selected sheets.
8. To select sheets for export, select a sheet number from the box under Sheet as model space.
9. Under Sheets as paper space, click 
to add a sheet to the Selected column or 
to remove a sheet from the Selected column.
to add a sheet to the Selected column or to remove a sheet from the Selected column.10. Click the Misc tab.
◦ Select the Export Blanked Layers check box to include blanked layers in the export; clear the check box to exclude them.
◦ Under Assembly Structure, select As Layers or As Blocks.
You can also select either or both of the following options when exporting the assembly structure as blocks:
▪ Nested—Preserves the assembly and component hierarchy during export to AutoCAD.
▪ View Based—Creates assembly structure blocks for each view with the view block as the top block of each hierarchy.
| | You can configure these settings by clicking >  Options from the menu bar, selecting Configuration Editor on the Creo Parametric Options dialog box, and setting the intf_out_layer configuration option to none, part_layer, block_layer, block_nested_layer, block_view_based_layer, or block_nested_view_based_layer. |
◦ Retain the selection of Create Comments on the Export Environment for DXF dialog box to create comments in the DXF file.
| | Create Comments is not available on the Export Environment for DWG dialog box. |
◦ Select Preserve Breaks On Dimension Lines to export dimensions as geometric entities and preserve breaks on dimension lines.
◦ Select JPEG or retain the default PNG as the Image Format.
11. Click the Properties tab to customize the following properties:
◦ Line Fonts
◦ Text Fonts
◦ Colors
◦ Layers
12. Select Generate a log file to toggle the generation of an export log file. Click 
to open the export log file when the export is complete.
to open the export log file when the export is complete.13. Click OK in the Export Environment for DXF or the Export Environment for DWG dialog box to export the file and quit the dialog box, or click Export to export the file without closing the dialog box. In both cases, the export log file opens in the INFORMATION WINDOW and displays the export details. The settings in the dialog box are saved automatically.
14. Click Edit to edit the export log file.
15. Click > .
16. Click Close.
The drawing is exported to the DXF or the DWG format and a file is created. When only one sheet of a multisheet drawing is exported, the sheet number is #.
• <drawingname>.dxf or <drawingname>_#.dxf.
• <drawingname>.dwg or <drawingname>_#.dwg.