To Create a Standard Hole
1. Click > 
Hole. The Hole tab opens.
Hole. The Hole tab opens.2. Click 
Standard. The standard hole options are shown.
Standard. The standard hole options are shown.3. Select the approximate hole location on the model. This is your primary placement reference. The selection is highlighted, and preview geometry of the hole is displayed.
4. To relocate the hole, drag the primary placement handle to the new location or snap it to a reference.
5. To change the hole placement type select a new type from the placement Type box on the Placement tab.
6. Drag the offset placement reference handles to the appropriate references to constrain the hole. As you drag each handle, the available references are highlighted as your pointer moves over them. This enables you to target the correct reference. The system automatically snaps the handle to the reference and adds them to the Offset References collector on the Placement tab.
7. To align the hole with an offset reference, select the reference from the Offset References collector on the Placement tab and change Offset to Align.
 | You can change the reference type only for holes that use the  Linear placement type. |
8. To orient the hole to be parallel to or perpendicular to a reference:
a. Click the Placement tab, click the Hole orientation collector, and select a planar, axial, or linear reference.
b. Click 
to make the hole parallel to the orientation reference, or click 
to make the hole perpendicular to the orientation reference.
to make the hole parallel to the orientation reference, or click to make the hole perpendicular to the orientation reference.9. Select the hole profile:
Straight
Tapped
Clearance
Tapered10. In the 
Thread type list, select the industry-standard hole chart (ISO, ISO_7/1, NPT, NPTF, UNC, or UNF).
Thread type list, select the industry-standard hole chart (ISO, ISO_7/1, NPT, NPTF, UNC, or UNF).11. In the 
Screw size box, type or select a screw size.
Screw size box, type or select a screw size.| | If you enter a screw size that is not listed, the system selects the closest screw size. You can also drag the hole diameter handle to select a screw size. |
12. To define the hole depth, under Depth on the Hole tab, select a depth option, and depending on the option, type a depth value or drag the depth handle, or select a depth reference. The following depth options are available:
| | To define a new depth by dragging the depth handle, or by typing or selecting a new value, you must select the  Blind depth option. |
◦ Blind—Drills the hole from the placement reference to a specified depth. This is the default option.
Blind—Drills the hole from the placement reference to a specified depth. This is the default option.◦ 
To Next—Drills the hole up to the next surface of a solid. This option is not available in Assembly.
To Next—Drills the hole up to the next surface of a solid. This option is not available in Assembly.◦ 
Through All—Drills the hole to intersect with all surfaces.
Through All—Drills the hole to intersect with all surfaces.| | For holes created at the assembly level, when Through All is selected for the hole depth,  Through Thread cannot be selected for the thread depth. |
◦ 
Through Until—Drills the hole to intersect with the selected surface. The Depth Reference collectors activate on the Hole tab and on the Shape tab. This depth option is not available in Assembly.
Through Until—Drills the hole to intersect with the selected surface. The Depth Reference collectors activate on the Hole tab and on the Shape tab. This depth option is not available in Assembly.◦ 
To Reference—Drills the hole to the selected point, curve, plane, surface, quilt, or body. The Depth reference collectors activate on the Hole tab and on the Shape tab.
To Reference—Drills the hole to the selected point, curve, plane, surface, quilt, or body. The Depth reference collectors activate on the Hole tab and on the Shape tab.13. For tapered holes, to add a straight drill, on the Shape tab, select a depth option from the Straight drill list, or from the shortcut menu. The following depth options are available:
◦ Blind—Drills from the placement reference to a specified depth.
Blind—Drills from the placement reference to a specified depth.◦ To Next—Drills to the next surface.
To Next—Drills to the next surface.◦ Through All—Drills through all surfaces.
Through All—Drills through all surfaces.◦ Through Until—Drills to intersect with the selected surface.
Through Until—Drills to intersect with the selected surface.◦ To Reference—Drills to the selected surface, quilt, body, plane, curve, or point.
To Reference—Drills to the selected surface, quilt, body, plane, curve, or point.◦ 
None—Does not add a straight drill.
None—Does not add a straight drill.14. For tapered holes, to add a slanted surface at the bottom of the tapered drill, on the Shape tab, select the Tapered tip check box.
15. For tapped holes, to define the thread depth, click the Shape tab, and select one of the following options:
◦ Through Thread to thread the entire depth of the hole.
Through Thread to thread the entire depth of the hole.| | For holes created at the assembly level, when Through Thread is selected for the thread depth, Through All cannot be selected for the hole depth. |
◦ 
Blind, and then type a depth value.
Blind, and then type a depth value.◦ To Reference, and then select a surface, quilt, body, plane, edge, curve, axis, point, or vertex.
To Reference, and then select a surface, quilt, body, plane, edge, curve, axis, point, or vertex.16. To add countersink to the hole:
a. Click 
Countersink on the Hole tab.
Countersink on the Hole tab.b. To define the countersink diameter or angle, click the Shape tab, and type or select a new countersink 
diameter or countersink angle in the corresponding boxes.
diameter or countersink angle in the corresponding boxes.17. To add counterbore to the hole:
a. Click 
Counterbore on the Hole tab.
Counterbore on the Hole tab.b. To define the counterbore diameter or depth, click the Shape tab and type or select a new counterbore diameter or counterbore depth in the corresponding boxes.
diameter or counterbore depth in the corresponding boxes.18. To represent the hole with lightweight geometry, click 
Lightweight.
Lightweight.19. To ensure that the entire top of the hole intersects the outside of the solid geometry, on the Shape tab, select the Top Clearance check box.
20. To select the bodies from which geometry is removed, click the Body Options tab and select an option:
◦ To cut geometry from all the bodies that the feature passes through, select All.
◦ To cut geometry from selected bodies:
1. Select Selected.
2. Click the body collector, and then select bodies from which to cut geometry.
21. Click 
OK.
OK.