To Define Varied Dimensions for Flexibility
1. Open an assembly.
2. Choose one of the following items:
A flexible component—Select the component, right-click it in the Model Tree or graphics window, and select Flexible Component > Varied Items. The Varied Items dialog box opens.
A component without defined flexibility—Select the component, right-click it in the Model Tree or graphics window, and select Flexible Component > Make Flexible. The Component Placement tab opens with the Varied Items dialog box open.
3. To add a new Dimension varied item, click . The new dimension appears in the table.
4. Select the component with the dimension to vary in the graphics window. Dimensions display.
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When there are multiple dimensions in the model, click and use the Search Tool to find the required dimension.
5. Select the dimension and click OK. The new dimension appears in the table.
6. Enter a New Value for the feature dimension or select an option from the Method list:
By Value (default)—Enter a value in the New Value cell.
Curve Length—Opens the Length dialog box. Click Definition and select a curve or edge to define its value. Click Details to open the Chain dialog box. Set Standard or Rule-basedReferences for the curve chain. Rule-based references allow you to choose an anchor and chain type: Tangent, Partial loop, or Complete loop. Configure an Extent Reference for a partial loop chain and use Options if required.
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For more information on chains, search the Help Center.
Distance—Opens the Distance dialog box. Click Definition and select two entities to drive the new value.
Angle—Opens the Angle dialog box. Click Definition and select two entities to drive the new angle value.
Area—Opens the Area dialog box. Click Definition and select the surface to drive the new value.
Diameter—Opens the Diameter dialog box. Click Definition and select a round surface or edge to drive the new value. Click the Point box and select a point from which to begin the new diameter calculation.
7. Click .
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You can define a Geometric Tolerance for the varied dimension. Only the By Value option is applicable for setting a geometric tolerance.