About Bend Notes
Bend notes show information about the type, direction, and angle of a bend. They can also be displayed as annotations in your drawings to facilitate manufacturing when programming bending machines, locating punch positions, and creating dimension inspection documents. The following example shows a bend note:
Bend notes are automatically created for each bend in your design, they display on the flat pattern and unbend features of your model. You can customize the order of the note elements with the smt_bend_notes_order configuration option. You can also customize the default bend note symbols or create your own symbols by modifying the bend note display configuration options or by modifying the Bend notes display settings area in the Sheetmetal area of the Creo Parametric Options dialog box.
To display bend notes on the flat pattern and unbend features, click 
Bend Notes on the Graphics toolbar, or click > Bend Notes. Make sure that 
Annotation Display is enabled and that the smt_bend_notes_dflt_display configuration option is set to yes (default).
Bend Notes on the Graphics toolbar, or click > Bend Notes. Make sure that Annotation Display is enabled and that the smt_bend_notes_dflt_display configuration option is set to yes (default).To display bend notes in the Model Tree, click 
> . The Model Tree Items dialog box opens. Under Display, click Annotations, and then click OK.
> . The Model Tree Items dialog box opens. Under Display, click Annotations, and then click OK.Displaying Bend Note Information
To change the information displayed in a bend note, follow the steps below.
1. Click > . The Creo Parametric Options dialog box opens.
2. Under Core on the left, click Sheetmetal. The Set Sheetmetal options page opens.
3. Under Bend Notes Display Settings you can
◦ Change the order of the default parameters in the Bend note element order box. The default parameters are:
▪ &type—Displays the type of bend, formed or rolled.
▪ &direction—Displays the bend direction, up or down.
▪ &angle—Displays the inside bend angle.
◦ Add all or one of the following parameters:
▪ &compl_ang—Displays the complementary angle of the bend.
▪ &inner_radus—Displays the inner bend radius.
▪ &outer_radius—Displays the outer bend radius.