Configuration Options for Sheetmetal
default_abs_accuracy
<value>
Defines the default absolute part accuracy when a template is not used.
If you do not define a default value for the default_abs_accuracy configuration option, the value 0.00039 inch or 0.01 mm is assigned as the default value, depending on the unit system that you use.
die_models_directory
<creo_load_directory>*, <absolute directory path>
<creo_load_directory>—Uses the Creo Parametric load directory for the library of standard die models.
<absolute directory path>—Specifies a user-defined location to retrieve die models.
enable_flat_state
yes, no*
Makes the tool for creating a legacy flat state instance available in the Sheetmetal area of the Model Properties dialog box.
 |
When a legacy flat state instance is in the model, the configuration option is automatically set to yes.
|
flange_shape_sketches_directory
<creo_load_directory>*, <absolute directory path>
<creo_load_directory>—Uses the Creo Parametric load directory for the library of shapes for flange wall sketches.
<absolute directory path>—Sets a user-defined path to a library of shapes for flange wall sketches.
flat_shape_sketches_directory
<creo_load_directory>*, <absolute directory path>
<creo_load_directory>—Uses the Creo Parametric load directory for the library of shapes for flat wall sketches.
<absolute directory path>—Sets a user-defined path to a library of shapes for flat wall sketches.
flat_simp_rep_name
system*, a user supplied name
Sets the name to use as the default name for a flat simplified representation.
system—The configuration option smt_flat_simp_rep_name_format is used to generate the name.
User supplied name—Type a name to use as the default name of flat simplified representations of a sheet metal part.
initial_bend_y_factor
0.500000
The y-factor value is set to 0.500000.
Specify a constant used to determine the neutral bend line for a sheet metal part. This value is always used for non-regular bends. It is only used for regular bends when a bend table is not specified.
pro_sheet_met_dir
<full directory path>
Set the default directory for your user-defined bend tables. If not set, the supplied Sheetmetal Design bend tables are used.
You must type the full directory path in the Value box. For example, c:\program files\ptc\sheet metal projects.
pro_smt_params_dir
<full directory path>
Specify the directory to save/retrieve sheet metal parameters files. Type the full path name to avoid problems.
You must type the full directory path in the Value box. For example, c:\program files\ptc\sheet metal projects.
punch_axis_points
no*, yes
no—Disable the creation of punch axis points in sheet metal cuts and punches.
yes—Enable the creation of punch axis points in sheet metal cuts and punches.
Controls the creation of punch axis points in sheet metal cuts and punches.
punch_models_directory
<creo_load_directory>*, <absolute directory path>
<creo_load_directory>—Uses the Creo Parametric load directory for the library of standard punch form models.
<absolute directory path>—Specifies a user-defined location to retrieve punch form models.
smt_add_bends_on_sharp_edges
yes*, no
Adds bends automatically to geometry with sharp edges when creating walls.
smt_allow_flip_sketch
yes, no*
Controls if the Flip Angle and Flip profile commands are available for flat walls and flange walls, respectively.
yes—The Flip Angle command is available for flat walls and the Flip profile command is available for flange walls. You can flip the sketch using flat and flange wall tools.
no—The Flip Angle command is unavailable for flat walls and the Flip profile command is unavailable for flange walls.
smt_bend_notes_dflt_display
yes*, no
yes—Bend notes display.
no—Bend notes do not display.
Defines the default state of bend note display.
smt_bend_notes_direction_down
default
default—Uses 
to indicate downward bends.
to indicate downward bends.You can customize your bend line note symbol by modifying the symbol source files. Define the symbol used to indicate a downward bend in Sheetmetal mode.
| | To return to the default bend line note symbols, type default in the box. |
smt_bend_notes_direction_up
default
default—Uses 
to indicate upward bends.
to indicate upward bends.You can customize your bend line note symbol by modifying the symbol source files. Define the symbol used to indicate an upward bend in Sheetmetal mode.
| | To return to the default bend line note symbols type default in the Value box. |
smt_bend_notes_order
&type&direction&angle*
Sets the order and display of bend note elements. You can add the following elements to a bend note:
Note | Description |
|---|---|
&type | The bend type |
&direction | The direction of the bend |
&angle | The bend angle |
&inner_radius | The inner bend radius |
&outer_radius | The outer bend radius |
&compl_ang | The complementary angle |
A bend note can include elements in any order and can also include any string. The string will show in the note as text. For example, Note &angle R&inner_radius will show as ‘Note 90° R0.5’ when the bend angle is 90° and the inner radius is 0.5.
smt_bend_notes_type_formed
default
default—Uses 
to indicate formed bends.
to indicate formed bends.You can customize your bend line note symbol by modifying the symbol source files. Define the symbol used to indicate a formed bend in sheet metal mode.
| | To return to the default bend line note symbols type default in the Value box. |
smt_bend_notes_type_rolled
default
default—Uses 
to indicate rolled bends.
to indicate rolled bends.You can customize your bend line note symbol by modifying the symbol source files. Define the symbol used to indicate a rolled bend in sheet metal mode.
| | To return to the default bend line note symbols type default in the Value box. |
smt_crn_rel_display
yes*, no
yes—Corner relief notes will display.
no—Corner relief notes will not display.
Controls the display of corner relief notes.
smt_drive_bend_by_parameters
yes, no*
Sets the default value of the bend angle and bend dimension location settings and updates features automatically when parameter values change.
| | For this configuration option to take affect, you must also set the smt_drive_tools_by_parameters to yes. |
yes—Uses sheet metal parameters or uses the options set in the Sheetmetal Preferences dialog box to set the default values. Features update automatically.
no—Uses sheet metal parameters or uses the options set in the Sheetmetal Preferences dialog box to set the default values at the start of a session. Subsequently, tool settings display the last value used.
smt_drive_tools_by_parameters
yes*, no
Sets the default values of selected sheet metal tool settings and updates features automatically when parameter values change.
yes—Uses sheet metal parameters or uses the options set in the Sheetmetal Preferences dialog box to set default values of selected tool settings. Features update automatically.
no—Uses sheet metal parameters or uses the options set in the Sheetmetal Preferences dialog box to set default values of selected tool settings at the start of a session. Subsequently, tool settings display the last value used.
smt_flat_inst_index
remove_gaps*, incremental
Sets the way index numbers are appended to flat pattern instances.
remove_gaps—The new flat instance name index will be the first available index number. Gaps in index names are filled.
incremental—The new flat instance name index is the next incremental number. Gaps in index names are not filled.
smt_flat_instance_name_format
&part_name_&body_name_&body_state&running_index*, a user supplied name
Sets the naming format of the flat state instance.
&part_name_&body_name_&body_state&running_index—The name string supports any combination of the name elements, as well as custom text added as a prefix, a suffix, and in any place in the name string. For a Flat Pattern feature created without the Flat Pattern Manager, the &body_name is ignored.
Sets the order and display of flat instance name elements. You can add the following elements to an instance name:
Element | Description |
|---|---|
&part_name | The part name. |
&body_name | The body name. |
&body_state | The body state, flat or bent. |
&running_index | The index number of the instance. This is the always the last element in the name format. |
User defined—A name provided by the user.
smt_flat_rep_inst_option
instance & reresentation*, representation, instance
Sets the commands that display in the Flat Pattern list in the Sheetmetal tab Bends group.
instance & reresentation—Displays the Flat Pattern Representation and the Flat Pattern Instance commands.
instance—Displays only the Flat Pattern Instance command.
representation—Displays only the Flat Pattern Representation command.
smt_flat_simp_rep_name_format
&part_name_&body_name_&body_state_REP*, a user supplied name
Sets the naming format of the flat state representation.
&part_name_&body_name_&body_state_REP—The name string supports any combination of the name elements, as well as custom text added as a prefix, a suffix, and in any place in the name string. For a Flat Pattern feature created without the Flat Pattern Manager, the &body_name is ignored.
Sets the order and display of flat representation name elements. You can add the following elements to an instance name:
Element | Description |
|---|---|
&part_name | The part name |
&body_name | The body name |
&body_state | The body state, flat or bent |
_REP | Representation |
User defined—A name provided by the user.
smt_mp_method
cg*, mass, both
cg—Mass properties calculation is performed on current state of sheet metal part.
mass—Suppressed flat pattern and flat forms are temporary resumed before mass properties calculation of sheet metal part.
both—Both mass and cg methods are calculated.
Determines whether or not to include suppressed flat patterns and flat forms in your design's mass properties calculation.
smt_outside_mold_lines
yes, no*
yes—Outside mold lines are created during the flat pattern creation.
no—Outside mold lines are not created during the flat pattern creation.
Determines which mold lines to create during the flat pattern creation.
system_sheetmetal_color
0.000000 0.000000 0.000000
0.000000 0.000000 0.000000— Red=0.00, Green=0.00, Blue=0.00
Specifies the default color in which sheet metal parts are displayed. The three decimal values specify (in order) a percentage of red, green and blue in the resulting color. For example, 0 0 49 specifies a medium blue.
template_sheetmetalpart
inlbs_part_sheetmetal.prt, empty*, <filename>
inlbs_part_sheetmetal.prt—Use the inlbs_part_sheetmetal.prt file as the default template.
empty—Do not use a template.
<filename>—Use a specific file as your template.
Specifies the filename of the default sheet metal part model template. After you set this option, it takes effect immediately in the current session.