Detailed Drawings > Defining the Drawing Layout > Working with Model Views > Customizing Drawing Views > Displaying Sections of Views > To Create a 2D Cross Section in a Drawing
  
To Create a 2D Cross Section in a Drawing
1. Open a drawing.
2. Double-click an existing view. Alternatively, select a view, right-click and click Properties on the shortcut menu. The Drawing View dialog box opens.
3. Click Sections. The Sections category page is displayed in the Drawing View dialog box.
4. Click 2D cross-section. The options for creating or displaying a 2D cross section are displayed in the Sections category page. If a 2D cross section does not exist in the drawing, you will need to create a new one.
5. Click in the Sections page to create a new 2D cross section.
6. Select Create New from the Name list in the Sections page. The XSEC CREATE menu appears.
7. Define the cross section as either Planar or Offset. Select the appropriate attributes for Planar or Offset on the XSEC CREATE menu.
8. Click Done. You are prompted to type a name for the cross section.
9. Type a name and press ENTER. The SETUP PLANE menu appears. You are prompted to define the cross section reference.
10. Click Plane to select an existing reference or Make Datum to create a new one.
11. Middle-click when you have selected an existing plane or when you have created a new plane. The 2D cross section is placed in the drawing and the Drawing View dialog box closes.
 
* You can only display existing 3D cross sections in drawings. You cannot create a new 3D cross section in a drawing.
To restore a removed view label of cross section, select the view and right-click, on the shortcut menu, click Add View Label.