To Insert a Partial View
Partial views display geometry that exists inside of a sketched boundary.
1. Open a drawing with one or more views.
2. Double-click an existing view. Alternatively, select a view, right-click and click Properties on the shortcut menu. The Drawing View dialog box opens.
3. Click the Visible Area category. The Visible area options display in the dialog box.
4. Select Partial View from the View visibility list. The options for defining the view area display.
5. Select the geometry of the view near the center of the area you want to retain in the partial view. The selected item highlights.
6. Sketch a spline encompassing the area you want to show. Middle-click to end the sketching.
7. To display the boundary for the partial view contained within the spline, make sure Show spline boundary on view is selected. The boundary displays in geometry line font.
8. You can specify a plane parallel to the screen and exclude all graphics behind it by clicking Clip view in Z-direction and select an edge, surface, or datum plane clipping reference that is parallel to the view. When you perform Z-Clipping in a view, keep in mind the following:
◦ If the reference for the clipping plane cannot be regenerated, Z-Clipping does not take effect for the view (an error message appears).
◦ The Z-Clipping of a detailed view is always the same as that of its parent. You cannot modify it individually.
9. To continue defining other attributes of the drawing view, click Apply and then select the appropriate category. If you have completely defined the drawing view, click OK.