CoCreate OneSpace Designer - Commands Reference Manual

EXTRUDE creates a part by extruding a profile in a workplane.

Syntax

                    +----------------<-------------------------------------------------+
                    V                                                                  |
    -->--(EXTRUDE)--+--(PART)--|select part|-------------------------------------------+------>--
                    |                                                                  |
                    +--(WP)--|select wp|-----------------------------------------------+
                    |                                                                  |
                    +--(TYPE)--|select extrude-type|-----------------------------------+
                    |                                                                  |
                    +--(DISTANCE)--|measure_dist_sa|-----------------------------------+
                    |                                                                  |
                    +--(TO_PART)--|select face|----------------------------------------+
                    |                                                                  |
                    +--(TO_FACES)--|select face|---------------------------------------+
                    |                                                                  |
                    +--(TO_POINT)--|select point|--------------------------------------+
                    |                                                                  |
                    +--(TO_PLANE)--|select plane|--------------------------------------+
                    |                                                                  |
                    +--(DIRECTION)--|select direction|-+------------>--------------+---+
                    |                                  |                           |   |
                    |               DIRECTION=user_def.|                           |   |
                    |                                  +->--|MEASURE_DIR_SA|-------+   |
                    |                                                                  |
                    +--(AUTO_DIRECTION)--+--(YES)--+-----------------------------------+
                    |                    |         |                                   |
                    |                    +--(NO)---+                                   |
                    |                                                                  |
                    +--(KEEP_WP)--+--(YES)--+------------------------------------------+
                    |             |         |                                          |
                    |             +--(NO)---+                                          |
                    |                                                                  |
                    +--(KEEP_PROFILE)--+--(YES)--+-------------------------------------+
                                       |         |
                                       +--(NO)---+

Options

• :PART - specifies the part which will contain the extruded geometry.
• :WP - specifies the workplane containing the profile to be extruded.
• :TYPE - specifies the extrusion type. Select from the following types:

  Extrusion Type	Extrusion Type Option
  Distance:	:DISTANCE_TYPE
  To Part:	:TO_PART_TYPE
  To Faces:	:TO_FACES_TYPE
  To Point:	: TO_POINT_TYPE
  To Plane:	:TO_PLANE_TYPE

  The field corresponding to the selected extrusion type is activated.

  • :DISTANCE - specifies the distance through which the profile is extruded.
  • :TO_PART - specifies the part toward which the profile is extruded.
  • :TO_FACE - specifies the face toward which the profile is extruded.
  • :TO_POINT - specifies a point toward which the profile is extruded.
  • :TO_PLANE - specifies a plane toward which the profile is extruded.
• :DIRECTION - specifies the direction of the extrusion. Choose from the following options:

  Direction Option	Description
  :+W	Extrude in the direction of the positive normal of the workplane containing the profile.
  :-W	Extrude in the direction of the negative normal of the workplane containing the profile.
  :BOTH_SIDES	Extrude to both sides of the workplane. Only active for :DISTANCE_TYPE extrusions. OneSpace Designer extrudes the specified distance on both sides of the workplane.
  :USER_DEF	Extrude in a direction specified by way of the MEASURE_DIR_SA. Only active for :DISTANCE_TYPE extrusions.

• :AUTO_DIRECTION - when set to :YES, OneSpace Designer attempts to set the direction of the extrude operation automatically according to the extrude type option:

  Extrude Type Option	Automatically Selected Direction
  :DISTANCE_TYPE	If an existing part is selected and it is not empty, the direction is toward the part. If a new part, or an empty part is selected, the direction is the negative normal of the selected workplane.
  :TO_PART_TYPE	Toward the selected part.
  :TO_FACES_TYPE	Toward the selected faces.
  : TO_POINT_TYPE	Toward the selected point.
  :TO_PLANE_TYPE	Toward the selected plane.

  A user-specified direction overrides the :AUTO_DIRECTION option.

• :KEEP_WP - selects whether to keep the workplane on completion of the extrusion.
• :KEEP_PROFILE - selects whether to keep the profile(s) on completion of the extrusion. When set to :NO, the workplane is cleared of 2D geometry after the operation.

When to use

The default extrude control box is displayed:

Part:           /p1
Workplane:      /w1
Extrude:
Direction:

[ ] Keep Wp   [ ] Keep Prof

You must supply the information as specified in the syntax diagram.

Rules for use

• Toward a part, a face or faces, a point, or a plane; or through a specified distance in a user-specified direction.
• Relative to the active workplane coordinate system.
• Relative to the current global coordinate system.

It is not possible to extrude a part in a direction parallel to the active workplane.

Example

1. Enter EXTRUDE to display the default control box. OneSpace Designer also displays the icon showing the default extrusion direction.
2. Specify the part to be extruded, the current part is the default.
3. Specify the active workplane.
4. Enter a distance of 20.
5. Choose to extrude To Faces.
6. Specify a face to extrude toward.
7. Enter COMPLETE to tell OneSpace Designer that you have finished setting up the operation.

See also