Manufacturing > Turning > To Create an Area Turning NC Sequence
  
To Create an Area Turning NC Sequence
1. Ensure that the current operation references a Lathe or Mill/Turn workcell.
2. Click Turn > Area Turning. The Area Turning tab opens.
To create or edit an area turning step from the Process Manager, perform the following steps:
a. Click Manufacturing > Process Manager. The Manufacturing Process Table dialog box opens.
b. Click or click Insert > Step > Turning step. The Create Turning Step dialog box opens.
c. Specify the Type of step as AREA TURNING to insert a new area turning step.
d. Select a new step or existing step and click Edit Definition to open the Area Turning tab.
3. Select (default) to use Head 1 in the turning sequence or to use Head 2 in the turning sequence.
4. Click Tool Manager or select Edit Tools from the tool list box to open the Tools Setup dialog box and add a new cutting tool.
Alternatively, right-click in the graphics window and select Tools.
5. On the Parameters tab, specify the required basic manufacturing parameters. You can also click to define advanced machining parameters or click to copy machining parameters from another step. By default, the required parameters are defined by relations that you can modify from the Relations dialog box.
Alternatively, right-click in the graphics window and select Parameters.
6. On the Clearance, Process, and Properties tabs, specify any additional values.
7. On the Tool Motions tab, define the area turning cut:
 
* The Tool Motions tab is available only after you have defined the mandatory parameters like tool and step parameters.
8. Select Area Turning from the list on the Tool Motions tab. The Area Turning Cut dialog box opens.
a. To define a stock boundary, click in the Stock collector to select a workpiece or stock boundary feature to represent the stock boundary.
Alternatively, right-click the graphics window and select Turn Stock Boundary Collector.
To create a new stock boundary, click Geometry > Stock Boundary on the Area Turning tab. The Stock Boundary tab opens. To create a stock boundary, see the Related Links.
b. To select an existing turn profile, click the Turn Profile collector
Alternatively, right-click the graphics window and select Turn Profile.
To create a new turn profile, click Geometry > Turn Profile on the Area Turning tab. The Turn Profile tab opens. To create a turn profile, see the Related Links.
c. Select the Start Extension and End Extension options to extend the ends of the turn profile to intersect the stock.
Alternatively, right-click the start or end point of turn profile and select No Extension, Add Extension, and Next Extension.
d. Adjust the cut motion ends under Options.
Alternatively, right-click the graphics window and select Start Point and End Point.
e. Specify the corner conditions as Sharp, Fillet, or Chamfer under Corners.
f. Click OK.
9. On the Tool Motions tab, create additional approach motions, exit motions, CL commands, and Goto motions by selecting options from the list.
10. To animate the tool path display, click on the Area Turning tab. Modify any parameter to adjust the tool path.
11. Click .
 
* You can use the object-action behavior by selecting a predefined turn profile from the Model Tree and clicking Turn > Area Turning. After specifying the mandatory step parameters and tool parameters, the tool motion is automatically defined based on the selected turn profile.