About Making Design Changes to non-Creo Models
You can make design changes to Autodesk Inventor, CATIA, SolidWorks, NX, and Creo Elements/Direct models in Creo just as you modify Creo models. You can add features such as protrusions, holes, and rounds to the non-Creo models in Creo and thereafter edit and modify the features that you defined in Creo. You can also create datum features such as planes, axes, points, coordinate systems, and curves for reference and add annotation features for use in downstream applications.
The addition of model features to the non-Creo models and their redefinition in Creo constitute major design changes. However, the addition of datum and annotation features or layer, color, and parameter changes do not actually modify the model designs. Regardless of the nature of changes, the geometric, datum, and other modifications are not propagated to the source models of the non-Creo models.
When you initiate design changes to the non-Creo models in Creo, the Confirmation dialog box provides the following options:
• Convert—Converts the non-Creo models to Creo Translated Image Models (TIMs).
• Do not convert—Does not convert the non-Creo models to Creo models.
You can modify the non-Creo models in Creo and apply the design changes to the models as follows:
• If you retain the default option of Convert on the Confirmation dialog box, the non-Creo models are converted to Creo TIM parts and assemblies. The Creo TIM parts and assemblies replace the non-Creo components in the assembly models and continue to remain active. You can resume the design changes on the Creo TIM parts and assemblies and apply the design changes to the Creo TIM parts and assemblies. The Creo TIM parts and assemblies have object identities that are separate from the non-Creo source CAD models.
When the conversion is automatic, the Creo TIM parts and assemblies retain their system-defined model names. If you use the advanced tools for the conversion, you can rename the TIM parts and assemblies.
• If you click Do not convert on the Confirmation dialog box, you can continue to modify the non-Creo models in Creo without converting them to Creo TIM parts and assemblies. You can then apply the design changes to the non-Creo models. The design changes that you apply to the non-Creo models are not reflected in the source CAD models. The modified non-Creo models are distinctly different from their non-Creo source CAD models in design though they have the same object identities and model names.
The
confirm_on_edit_foreign_models configuration option controls the display of the
Confirmation dialog box.
To explicitly convert the model to a TIM part or assembly without initiating the design changes, you can select a non-Creo model on the Model Tree and click Model > Operations > Convert to new Creo models.
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 When a non- Creo model is the top assembly, a warning prompts you to use the Save a Copy dialog box and convert the non- Creo top assembly model to a Creo model when you try to modify the component models. |
In the Creo-Windchill connected mode, the Conflicts dialog box prompts you to check out the non-Creo models that you retrieved from the Windchill servers for the design changes. When you try to convert the non-Creo models to Creo TIM parts and assemblies, a warning dialog box alerts you about the existence of TIM parts and assemblies on the Windchill server for the non-Creo models. It recommends that you reuse the existing TIM parts and assemblies for the design changes instead of converting the non-Creo models to additional TIM parts and assemblies.