To Create an Offset Wall

Sheetmetal > Designing in Sheetmetal Design > Creating and Modifying Walls > Modifying Walls > Offseting Walls > To Create an Offset Wall

1. Click Sheetmetal > Walls >

Offset. The Offset tab opens.

2. Select a quilt, a solid body, or surface as a reference for the offset.

Alternatively, you can first select the geometry and then click Walls >

Offset.

3. For a first wall, type a value for the wall thickness in the

box, or accept the default value. Click

to change the thickness direction.

4. Type a value in the

box to set the offset distance. Click

to flip the offset direction.

5. Click Options. The Options tab opens. Perform any of the following operations:

◦ Click the Special Handling collector and select one or more surfaces to exclude.

For more information about excluding surfaces, search the Help Center.

◦ Set sheetmetal-specific options:

▪ Click Add bends on sharp edges to round sharp edges when the sketch includes nontangent geometry. Set the value of the radius and the location for dimensioning the radius.

▪ To set options for merging an additional wall to the model, set the options below:

▪ Select Merge to model to merge the wall to an existing wall in the design. You now have the option to keep the edges of merged geometry and edges of bend surfaces. This option is not available for a first wall.

▪ Select Do not merge to model to keep the new geometry as a distinct piece. You now have the option to flip the driving surface of the sheet metal.

6. To set feature-specific bend allowance and calculate the developed length using a different method from that of the part, perform the following operations:

a. Click Bend Allowance. The Bend Allowance tab opens.

b. Click Use feature settings.

c. Perform one of the following operations:

▪ Click By K factor or By Y factor and type a new factor value or select one from the list.

▪ To use a bend table to calculate developed length for arcs, click By bend table. Use the default table, select a new one from the list, or click Browse to browse to a different table.

Only bend tables copied to the part are available.

7. Click