To Insert a General View
A general view is usually the first view placed on a sheet. It is the most versatile view in that it can be scaled or rotated to any setting.
1. Open a drawing.
2. Click > 
General. Alternatively, right-click and click Insert General View on the shortcut menu. If user-defined combination states exist, the Select Combined State dialog box opens. Under Combined state names, a list of user-defined combination states is displayed.
General. Alternatively, right-click and click Insert General View on the shortcut menu. If user-defined combination states exist, the Select Combined State dialog box opens. Under Combined state names, a list of user-defined combination states is displayed.3. Select a state or select No Combined State.
 | When you select a combination state, the Model view names, Simplified representation, Combined state, Assembly explode state, and 2D cross-section or 3D cross-section boxes in the Drawing View dialog box are automatically updated based on what is stored in the selected presentation. |
4. If you do not want to be prompted to select a combination state, click the Do not prompt for combined state check box.
5. Click a location to place the general view. The general view appears with the orientation specified by the selected combination state and the Drawing View dialog box opens. By default, the View Type category is selected and the options for defining the view type and orientation are displayed.
6. If required, you can modify the view name in the View name box and change the view type from the options in the Type list.
7. To change the current orientation, under View orientation, select from the following orientation methods:
◦ Views names from the model—Orient the view using saved views from the model.
Select the appropriate model view from the Model view names list.
| | While creating the view, if you have selected a combination state, then the named orientation in the selected combination is retained in the Model view names list. If this named view is changed, then the combination state is no longer listed. |
Define the x and y orientation by selecting the desired Default orientation. You can select either Isometric, Trimetric, or User Defined. For User Defined you must specify the custom angle values.
◦ Geometry references—Orient the view using geometry references from the previewed model in the drawing.
Select the direction to orient the reference from the list next to the reference being defined. The list provides several options, including Front, Back, Top, and Bottom.
Select the required reference on the model previewed on the drawing. The model repositions according to the direction defined and the references selected.
You can change the orientation by selecting another direction from the direction list. You can change the selected reference by clicking the reference collector and selecting a new reference on the drawing model.
| | To return the view to its original orientation, click Default Orientation. |
◦ Angles—Orient the view using angles of selected references or custom angles.
The Reference Angle table lists the references used to orient the view. By default, a new reference is added to the list and highlighted.
Select the desired option from the Rotation reference box for the highlighted reference in the table:
Normal—Rotate the model around an axis through the view origin and normal to the drawing sheet.
Vertical—Rotate the model around an axis through the view origin and vertical to the drawing sheet.
Horizontal—Rotate the model around an axis through the view origin and horizontal to the drawing sheet.
Edge/Axis—Rotate the model around an axis through the view origin and according to the designated angle to the drawing sheet. Select an appropriate edge or axis reference on the previewed drawing view. The selected reference is highlighted and is listed in the Reference Angle table.
◦ Type an angle value for the reference in the Angle Value box.
| | To create additional references, click and repeat the angle orientation process. |
8. To continue defining other attributes of the drawing view, click Apply and then select the appropriate category. If you have completely defined the drawing view, click OK.
| | If you delete or suppress geometry that is used to orient a view, the system changes that view and its children to the default orientation. You cannot recover the original view orientation if you delete the geometry. Resuming a suppressed feature, however, restores the original orientation of the view. |