To Import a Creo Elements/Direct Associative Drawing and Model
1. Click File > Open. The File Open dialog box opens.
2. Select Creo Elements/Direct Drawing (.mi, .bi, .bdl) in the Type box.
3. Select a *.mi, *.bi, or a *.bdl file or browse to the required file.
4. Click Import. The Import New Model dialog box opens.
Drawing is the default option when you select a *.mi or a *.bi file. The model type is, however, set as Part or Assembly when you select a *.bdl file, depending on whether the selected file contains a part or assembly model.
5. If you selected a *.bdl file, change Part or Assembly to Drawing to import the *.bdl file as a part or assembly drawing.
6. Accept the default file name or type a new name for the file.
7. Click OK. The Import MI dialog box opens.
8. Under Views, click Drawing associative with model to import the views in the *.mi, *.bi, or the *.bdl file as 3D views and import the 3D model and the associated drawing.
When you select a *.mi or a *.bi file for associative import, the Select a model text box and the Browse option are available in the Import MI dialog box only when the selected file contains associative data.
9. Type the location of the related 3D model file in the Select a model text box or click Browse and browse to the location of the file. You can select a Creo Elements/Direct*.pkg, *.sdp, *.sda, *.sdac, or *.sdpc file or a Creo Parametric*.prt or *.asm file with previously imported data.
If you try to close the Import MI dialog box without specifying the location of the 3D model file or selecting the 3D model file, a message prompts you to specify the 3D model file. A message also warns you that you cannot access the selected file when the 3D model file you specify does not exist or when the drawing does not fit the selected model.
10. Set the following model import options:
The Model import profile shows the import profile being used. For more information on how to create import profiles, see To Create Import Profile at Runtime.
Include containers / stock-finish relation
Include face parts
Include wire parts
Include empty parts
For more information on model import options, see About Creo Elements/Direct 3D import Options in Profiles
You are recommended to set these options, intf2d_in_ced_3d_containers, intf2d_in_ced_3d_empty_parts, intf2d_in_ced_3d_face_parts, intf2d_in_ced_3d_wire_parts, in the Configuration Editor. You can still modify the options at runtime. These settings override the settings in the import profile.
11. Set the following drawing import options:
From the Map Text Symbols To list, select the font type that you want to assign to imported text symbols.
This option is available when you import a drawing in a new file.
This option overrides the intf2d_in_symbol_font configuration option for the session.
For more information, see Mapping Imported Text Symbols.
Import symbol parts as symbols—Imports and maps the Creo Elements/Direct symbol parts to symbols in Creo Parametric. This option is selected by default.
If this option is not selected, symbol parts are not imported as symbols. In the case of leadered symbols, when symbol parts are not imported as symbols, the leaders do not remain attached to the symbols.
Import points—Imports point entities as drawing points.
Create variable size sheet—Creates drawing sheets of different sizes, especially for a multiple-sheet drawing with sheets of variable size. You are recommended to retain the default selection.
Create multi-line text—Imports multiple-line text as a single multiple-line note. You are recommended to retain the default selection.
12. Click the Mapping Properties tab to customize the following properties:
Hatch line fonts
Text fonts
Line fonts
13. Click the tab for colors, layers, line fonts, hatch line fonts, or text fonts and select a cell in the MI to Creo Parametric mapping table to change the value of the color, layer, line, or text font.
The following options on the Colors tab allow you to map MI colors to standard Creo Parametric or user-defined colors:
Creo Parametric—Maps MI standard colors to standard Creo Parametric colors.
MI—Maps MI standard colors to user-defined colors in Creo Parametric that have the same RGB values.
14. Click Open log window to display the import log file in the Information Window.
15. Click Save Mappings to save the current import settings on the Mapping Properties tab to the mapping file.
16. Click OK in the Import MI dialog box.
The drawing and its associated model are loaded in session.
Sheet-based layers named SHEET_<sheet_id>_NON_ASSOC_ANNOTATIONS are created by default for non-associative annotations.
Configuration options and their values that correspond with the import settings on the Import MI dialog box that were modified at runtime are saved to the file.