To Define Dimension Boundaries in an Inheritance Feature

Assembly Design > Assembly Design > Top Down Design > Data Sharing > Merge and Inheritance Features > Inheritance Features > To Define Dimension Boundaries in an Inheritance Feature

1. Retrieve an assembly, select a part in it, right-click, and choose Activate.

2. Select a second part in the assembly as the reference model from which geometry will be copied and click Get Data > Merge/Inheritance. The Merge/Inheritance tab opens with the reference model selected by default. You can select a different part as the reference model from the Model Tree or in the graphics window.

3. Click

Merge/Inheritance to toggle between Merge mode (default) and Inheritance mode.

4. Define varied dimensions.

5. Click

. The Varied Dimension Table Column Setup dialog box opens.

6. Select New Dim Bound from the Not Displayed list and then click

. New Dim Bound moves to the Displayed section.

7. Click OK. The Varied Dimension Table Column Setup dialog box closes.

8. Select a dimension from the Varied Items list, then click in the New Dim Bound cell and select one of the following value limits from list:

◦ Upper—Sets the dimension value to its maximum (generates geometry based on a nominal dimension value plus the tolerance).

◦ Middle—Sets the dimension value to the nominal value plus the mean of the upper and lower tolerance values.

◦ Lower—Sets the dimension value to its minimum (generates geometry based on a nominal dimension value minus the tolerance).

◦ Nominal—Sets the dimension value to nominal (generates geometry based on exact ideal dimensions).

9. Click OK.

To redefine the varied dimension boundaries, right-click the Inheritance feature in the Model Tree, and select Varied Items from the shortcut menu. The Varied Items dialog box opens.