Sheetmetal > Designing in Sheetmetal Design > Creating and Modifying Walls > Creating Walls > Extruded Walls > To Create an Unattached Extruded Wall
To Create an Unattached Extruded Wall
1. Click Sheetmetal > Extrude. The Extrude tab opens.
2. The Placement tab is open by default.
◦ To create a new sketch, click Define and set references. Create a sketch and click OK.
◦ To use an existing sketch, you must break the association with it by clicking Unlink. An internal sketch is created using a copy of the sketch.
3. Select a Depth option. To set depth for each side of the sketch, click Options to open the Options tab. Select a Depth option and a value for each side.
◦ Click Add bends on sharp edges to round sharp edges when the sketch includes nontangent geometry. Set the value of the radius and the location for dimensioning the radius.
◦ To set options for merging an additional wall to the model, set the options below:
▪ Select Merge to body to merge the wall to an existing wall in the body. You now have the option to keep the edges of merged geometry and edges of bend surfaces. This option is not available for a first wall.
▪ Select Do not merge to body to keep the new geometry as a disjoint volume. You now have the option to flip the driving surface of the sheet metal.
4. To create the new wall as a new body or to add the new wall to a different body, click Body Options. The Body Options tab opens.
◦ To create a new body, select the Create new body check box. A new body is created.
Click Link to part to link the preferences of the new body to the part preferences.
◦ To add the new wall to a different, existing body, select the body in the Model Tree or graphics window. The name updates in the body collector.
5. To set feature-specific bend allowance and calculate the developed length using a different method from that of the part, perform the following operations:
a. Click Bend Allowance. The Bend Allowance tab opens.
b. Click Use feature settings.
c. Perform one of the following operations:
▪ Click By K factor or By Y factor and type a new factor value or select one from the list.
▪ To use a bend table to calculate developed length for arcs, click By bend table. Use the default table, select a new one from the list, or click Browse to browse to a different table.
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Only bend tables copied to the part are available.
6. To flip the depth direction, click .
7. The thickness of a first wall can be changed only when the body is not linked to the part. Type a value for the wall thickness in the Thickness box, or accept the default value. Click to change the side the thickness is added.
8. Click .
About the Extrude Tool in Sheetmetal Design
About the Extrude User Interface for Sheetmetal Design
To Copy or Delete a Bend Table
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