Dialog Field (Keyword) | Type | Label | Description |
---|---|---|---|
Face (SEL_FACE) | Face with 3D Position | Specifies the cylindrical face for the threading operation. This face will automatically define the axis of the thread; from the point clicked the command will detect which side of the cylinder will be used for the reference of all the length values. | |
Ref. Elem (THREAD_LENGTH_REF_ELEM) | Reference Element with 3D Position | Specifies the reference element used as starting reference for all the length values. The dialog tries to find a suitable reference element from the pick point of the SEL_FACE. This reference element may be a planar face perpendicular to the axis of the SEL_FACE, a spherical face with a center on the axis of the SEL_FACE, a circle (coaxial with the SEL_FACE), or a circular arc (coaxial with the SEL_FACE) In case of a spherical cap, the point on the axis will be used as starting reference. | |
TAP Units (TAP_UNITS) | Keyword | Currently, the following threads are supported: :METRIC :INCH :BSW :BSF :BSP :UNC :UNF :NPT :PIPE_RP :PIPE_G :TRAPEZOID :FLAT_TRAPEZOID :SAW :ROUND :ROUND_MINING :EDISON :PIPE_JIS_B_0203 :PIPE_Pg :metric_fine The default is :metric (metric threads), if you have a metric length unit set; the default is :inch if you have an imperial length unit set. | |
Thread Diameter (THREAD_DIA) | Length | D1 | The nominal diameter of the thread. |
Thread Pitch (THREAD_SIZE) | Length | The pitch of the thread. | |
ThreadTpi (THREAD_TPI) | Number | Alternative method to specify the pitch of the thread by entering the Thread Per Inch value for all imperial style threads and pipe threads. | |
Starts (THREAD_STARTS) | Number | The number of thread starts. This value has no effect upon the geometrical representation of the threaded hole, but the data is needed for complete specification of the thread in order to create correct manufacturing documents. The default is 1. | |
Direction (THREAD_HAND) | Keyword | The direction of the thread. This value has no effect upon the geometrical representation of the threaded hole, but the data is needed for complete specification of the thread in order to create correct manufacturing documents. The following keywords are possible : :right (the default) :left | |
Nom.PipeDia. (NOMINAL_PIPE_DIA) | Length | The nominal diameter of a pipe thread, which is not the "outer" diameter of the thread. This value has no effect upon the geometrical representation of the threaded hole, but the data is needed for complete specification of the pipe thread in order to create correct manufacturing documents. | |
Thread Length (THREAD_LENGTH) | TolerancedLength | T1 | The length of the thread. |
Groove Width (GROOVE_WIDTH) | TolerancedLength | T3 | Specifies the width of the groove adjacent to the thread for clearance reasons. |
Groove Diameter (THREAD_GROOVE_DIA) | TolerancedLength | D2 | Specifies the diameter of the groove adjacent to the thread for clearance reasons. |
Chamfer Depth (CHAMFER_DEPTH) | Length | T2 | The depth of the front chamfer measured in direction of the axis. |
Chamfer Angle (CHAMFER_ANGLE) | Angle | The tip angle of chamfer cone. | |
Back Chamfer Depth (BACK_CHAMFER_DEPTH) | Length | T5 | The depth of the back chamfer measured in direction of the axis. This is the chamfer between the thread face and the groove. |
Back Chamfer Angle (BACK_CHAMFER_ANGLE) | Angle | The tip angle of the chamfer cone. | |
Groove Bottom Blend Rad (GROOVE_BOTTOM_RAD) | Length | R1 | The radius of the blends to be applied at the edges connecting the groove diameter face and the side faces of the groove. |
Name (NAME) | String | Specifies the name of the new feature. In case of modify, this name is fixed; to modify the name of a feature, use rename. | |
Flag DP (FLAG_DP) | The docuplane which should own the flag text. If you switch on the variable for the first time within a dialog, the computed defaults will be activated. If you decide not to use the docuplane for the flag text but want to get a free flag text, switch off the variable. You can reactivate your last value (within the same dialog) later by switching it on again. | ||
Dia DP (DIA_DP) | The docuplane which should own the diameter related dimensions. If you switch on the variable for the first time within a dialog, the computed defaults will be activated. If you decide not to use the docuplane for the dimensions but want to get a free dimension, switch off the variable. You can reactivate your last value (within the same dialog) later by switching it on again. | ||
Depth DP (DEPTH_DP) | The docuplane which should own the depth related dimensions. If you switch on the variable for the first time within a dialog, the computed defaults will be activated. If you decide not to use the docuplane for the dimensions but want to get a free dimension, switch off the variable. You can reactivate your last value (within the same dialog) later by switching it on again. |
Dialog Field (Keyword) | Type | Label | Description |
---|---|---|---|
(THREAD_TPI_NUM) | Non-negative Number | The numerator part of a rational thread per inch value for the thread pitch. This parameter is applicable to :NPT and :UNC type threads. For other type of threads, if a positive value occurs in a customization table, then the numerator value is forced to zero. | |
(THREAD_TPI_DEN) | Positive Number | The denominator part of a rational thread per inch value for the thread pitch. This parameter is applicable to :NPT and :UNC type threads. For other type of threads, if the value in a customization table is greater than one, then the denominator value is forced to one. |
Dialog Field (Keyword) | Type | Label | Description |
---|---|---|---|
(CHAM_DIA) | Non-negative length | An alternative method to specify the depth of the front chamfer. The chamfer diameter can be measured within the front face of the bolt. | |
(STD_TAP_CLEARANCE) | Positive Number | The difference between the total length and the thread length. This parameter has no effect upon the feature. | |
(GROOVE_DEPTH) | Non-negative length | Half of the difference between the thread diameter and the groove diameter. |
Dialog Field (Keyword) | Description |
Show/Hide Image (IMAGE_SHOWN) | Shows/hides the graphical representation of the machined hole. |
Show/Hide Tolerance & Quality (TOLERANCE_AND_QUALITY) | Shows/hides additional safety zone related input fields. |
Next (NEXT) | Completes the current operation and prompts you for the next location (create, copy) or feature (modify) without closing the menu. |