To Create a Flange Wall
1. Click
Model >
Flange. The
Flange tab opens.
2. Select an attachment edge. The selected edge is displayed in the Placement collector. An I-shaped flange wall is created by default.
|  When the attachment edge is linear, you can create both a swept flange wall and an extruded flange wall. By default, a swept flange wall is created. When the attachment edge is nonlinear, you can only create a swept flange wall. |
3. To choose a different flange wall shape, select one from the Shape list.
4. Click Shape. The Shape tab opens.
◦ To set the wall dimensions and attachment angle, use one of the following actions:
▪ Edit the wall dimensions and wall angle using the sketch window.
▪ Drag the handles to set the dimensions or to adjust the wall angle.
▪ Click a wall dimension or angle value and type a new value.
◦ To round sharp edges, click Add bends on sharp edges.
5. To flip the
material thickness direction, click
.
6. To set the length of each side of the flange wall, click a Flange End Location button or use the Length tab. Type a value or select a reference.
| When creating an extruded flange wall, the length options, None and Symmetric are also available. |
7. To add a bend to the attachment edge, click
.
8. Set the value for the bend radius using one of the following actions:
◦ Select a value from the Bend Radius list.
◦ Drag the handles into position.
◦ Edit the Bend Radius value.
9. Set the bend dimension location:
◦ Click
to dimension the radius from the outside surface of the wall.
◦ Click
to dimension the radius from the inside surface of the wall.
◦ Click
to dimension the radius according to the location controlled by the
SMT_DFLT_RADIUS_SIDE parameter.
10. To add the wall to an offset edge, click Offset. The Offset tab opens.
11. Select Offset wall with respect to attachment edge. Select an attachment option.
13. Click Relief. The Relief tab opens.
◦ To apply a different type of bend relief, perform the following steps:
1. Click Bend Relief and select a relief type to apply to both sides of the wall. For a Stretch relief, set the angle value and width. For Rectangular and Obround reliefs, set values for the depth, length, and width.
2. To define bend relief separately for each side, click Define each side separately.
3. Select a side and a relief type.
◦ To apply corner relief, perform the following steps:
1. Click Corner Relief.
2. Click the Define corner relief check box.
3. To create the relief geometry in the feature, click the Create relief geometry check box.
| When you clear the Create relief geometry check box, the relief is created only during unbend and flat pattern operations. |
4. Select a relief type and a relief anchor point. For Circular, Rectangular, Obround and, Square relief, perform these operations as necessary:
▪ Set the Origin and Orientation of the relief.
▪ Set the dimensions of the relief width and depth.
▪ Rotate the placement of the relief about the origin.
▪ Offset the relief perpendicular to the bisector.
14. To set feature-specific bend allowance and calculate the developed length using a different method from that of the part, perform the following operations:
a. Click Bend Allowance. The Bend Allowance tab opens.
b. Click Use feature settings.
c. Perform one of the following operations:
▪ Click By K factor or By Y factor and type a new factor value or select one from the list.
▪ To use a bend table to calculate developed length for arcs, click By bend table. Use the default table, select a new one from the list, or click Browse to browse to a different table.
| Only bend tables copied to the part are available. |
15. Click
.