• AXIS_SHIFT — Specify the axis shift of the tool along the work piece. Allows you to shift the CL data along the tool axis. If set to a positive value, all CL data shifts down along the tool axis; a negative value shifts the CL data up.

• BOTTOM_STOCK_ALLOW — Specify the amount of stock to be left after a sequence on planar surfaces parallel to the retract plane.

• CLEAR_DIST— Specify the clearance distance above the surface to be milled at which the rapid motion ends and the appropriate feed begins.

• CUT_ANGLE — Specify the angle between the cut direction and the X-axis of the NC Sequence coordinate system.

• CUT_TYPE — Specify the cut type. Combined with SPINDLE_SENSE, this parameter controls where the material is relative to the tool when the tool removes material.

◦ Upcut

◦ Zig-Zag

◦ Spiral — Available in HSM Finish and HSM Rest Finish sequences. It is not supported for PARALLEL_CUTS and FLAT_LANDS options.

• END_HEIGHT — Specify the end height for slices.

• HOLDER_CLEARANCE — Specify the minimum allowable distance between the tool holder and the machined surface. The parameter works in combination with any stock clearance defined.

• PULLOUT_DIST — Specify the height above the level of the cut, for example, the slice just milled, up to which the tip of the tool retracts at CUT_FEED and then changes to FREE_FEED. If FREE_FEED is not defined, the tool retracts at Rapid.

• SCALLOP_HGT — Specify the maximum allowable scallop height to control the tool step depth/step over.

• SLICE_PATH_SCAN — Specify the order of machining multiple passes within multiple step depths or slices.

◦ PASS_BY_PASS — Activates region-wise machining. The tool completes all slices in one region and then moves to machine the next region.

◦ SLICE_BY_SLICE — Activates slice-wise machining. All the first slices of the regions are one-by-one machined leading on to the second slices.

• START_HEIGHT — Specify the start height for slices.

• STEP_OVER — Specify the parameter to control the lateral depth of cut.

• TOLERANCE — Machine tools move in small straight line increments to approximate curved geometry. Specify the maximum distance that the straight line path deviates from the curved geometry.

• TRIM_TOOLPATH_ON_HOLDER — Divide the tool path into colliding and non-colliding zones provided that the HOLDER_DIAMETER and HOLDER_LENGTH parameters are set. In the colliding zone, the tool holder collides with the reference part and the toolpath gets trimmed, whereas there is no collision in the non-colliding zone. The resultant tool path is the combination of all non-colliding zones.

• SCAN_TYPE — Specify the way a milling tool scans the horizontal cross-section of a milling volume and avoids islands.

◦ TYPE_1 — Creates parallel cuts on multiple depths.

◦ TYPE_SPIRAL — Generates a spiral cutter path.

◦ CONSTANT_LOAD — Ensures that the cutting conditions remain almost constant. This offers improvements over conventional constant offset roughing strategies. The strategy avoids full-width cuts by constantly measuring the engagement volume of the tool with material, and gradually removing material from the remaining stock. The stable load on the tool allows an increased material removal rate at higher feed rates and reduces the overall machining time.

• ROUGH_OPTION — Specify whether a profiling pass must occur during roughing or rest roughing.

◦ ROUGH_ONLY — Create an NC sequence with no profiling.

◦ ROUGH_&_PROF — Create an NC sequence that rough cuts and profiles the stock in Mill window. It applies to TYPE_1 scan type.

• INTERMEDIATE_SLICE_ADJUST — Define when the intermediate slices must be created. Use this option in combination with the NUMBER_INTERMEDIATE_SLICES parameter.

◦ DURING — Create intermediate slices during machining passes.

◦ AFTER — Create intermediate slices after the last slice is machined.

• ROUGH_STOCK_ALLOW — Define the amount of stock to be left in the radial direction after the rough cut.

• MAX_STEP_DEPTH — Specify the maximum allowed step depth. After finding the positions of the highest and lowest slices, the actual step depth is calculated, which is less than or equal to the specified MAX_STEP_DEPTH.

• MACHINE_FLATLANDS — Select to machine true flat surfaces of the mold parts. This option helps you to machine flat surfaces on Z axis such as parting surfaces.

• MINIMUM_WIDTH — Specify the minimum width. Areas that have a width smaller than the specified width are not machined. Applicable when MACHINE_FLATLANDS is activated.

• FILTER_TYPE — Select the type of region to be filtered out while machining. It is specified in relation with the threshold percentage of the tool diameter. It is used to avoid machining of unnecessary regions.

◦ INSCRIBED_CIRCLE — Indicates that the maximum region width filtered is a circle diameter, which is inscribed into toolpath within such a region.

◦ DIAGONAL_LENGTH — Indicates that the maximum region width is a diagonal of axis-aligned bounding box built around the toolpath within this region.

• THRESHOLD_VALUE_PERCENT — Specify the threshold value in percent of the tool diameter. This value determines the width of a region to be filtered out while machining.

• REMOVE_CORNER_PEGS — Select to add extra toolpath around the corners that removes small pegs of material in the corners.

• NUMBER_INTERMEDIATE_SLICES — Specify the number of slices to be created. The intermediate slice is a Profile slice between the rough slices. The INTERMEDIATE_SLICE_ADJUST parameter dictates when the slices are created.

• DETECT_THICKER_THAN — Specify the thickness. It allows to avoid machining of the areas where amount of stock material is less then specified thickness threshold value.

• PREVIOUS_ROUGH_STOCK_ALLOW — Specify the amount of stock left by the previous roughing portion of the toolpath.

• PREVIOUS_BOTTOM_STOCK_ALLOW — Specify the amount of stock left by the previous roughing portion of the toolpath on the surface parallel to the retract plane.

• ALLOW_ENTRY_OUTSIDE — Select YES to allow the tool to enter from outside the stock or mill window.

• CLOSED_AREA_ENTRY — Specify the entry method for closed areas.

◦ Automatic — Tool takes the best suited entry for closed area.

◦ Helical — Tool enters a closed area by following a helical trajectory. The diameter of the helix is specified by the HELICAL_DIAMETER_PERC parameter.

◦ Radial — Tool radially engages with the stock in a closed area. This option does not work with CONSTANT_LOAD.

• RAMP_ANGLE — Specify the angle with which the tool enters the next slice or pass.

• HELICAL_DIAMETER_PERC — Specify the maximum allowed helix diameter in percent of the tool diameter. This applies for helical entry of the tool.

• LEAD_RADIUS — Specify the radius of the tangential circular movement of the tool when leading in or out.

• CUT_ENTRY_EXIT_EXT — Select the approach direction of the tool.

◦ NONE — Tool enters or exits without any lead in and out motion.

◦ TANGENTIAL_ARC — Tool takes horizontal arc for steep areas and vertical arc for shallow areas while leading in and out.

◦ VERTICAL_TANG_ARC — Tool takes vertical arc for all areas while leading in and out.

◦ HORIZONTAL_TANG_ARC — Tool takes horizontal arc for all areas while leading in and out

• FINISH_OPTION — Specify the machining method to create an optimized tool path.

◦ CONSTANT_Z — Finishes vertical surfaces or steep areas.

◦ CONSTNAT_CUSP — Creates equidistant cusps in steep as well as shallow areas. The aim is to have a constant distance between each contour so that the cusps are created with the equal height.

◦ SMART_CUTS — Creates combined toolpath which consists of Constant Z slices for steep areas and Constant cusp cuts for shallow areas of a part.

◦ PARALLEL_CUTS — Creates parallel cuts on X-Y plane. Use it for shallow areas.

◦ FLAT_LANDS — Creates toolpath to machine true flat regions of stock. Applicable only for Finish Sequences.

◦ PENCIL_CUT — Creates single toolpath for the inlaying edges. Application only for Rest Finish sequences.

• SPIRAL_SCAN_DIRECTION — Specify the direction of the toolpath for spiral scan.

◦ OUTSIDE_IN — From border to the center

◦ INSIDE_OUT — From center to the border

• STEEP_STEP_OVER — Specify the value of step over when machining a steep area. If a value is not specified for STEEP_STEP_OVER, then the STEP_OVER value is used as the STEEP_STEP_OVER value.

• FINISH_STOCK_ALLOW — Specify the amount of stock to be left after machining.

• REST_AREA_OFFSET — Specify the offset value to be applied to the computed rest area. The rest material area is calculated based on the previous tool used.

• SLOPE_ANGLE_START — Specify the start angle. The SLOPE_ANGLE_START and SLOPE_ANGLE_END form an interval. You can machine surfaces that fall in or out of this interval. The steep areas and shallow areas are detected automatically. The view direction and the angles that form the interval define these areas.

◦ Start angle must be smaller than the end angle.

◦ If the step over value is greater than the area you defined by the start and end angles, toolpath is not generated.

• SLOPE_ANGLE_END — Refer to SLOPE_ANGLE_START described previously.

• OPTIMAL_ANGLE — Select YES to automatically determine the direction where the number of cuts will be minimal.

• MULTI_PENCIL_PASSES — Specify the number of passes on each side of the pencil cuts.

• DETECT_THICKER_THAN —Specify the thickness. It allows to avoid machining of the areas where amount of stock material is less then specified thickness threshold value.