You can move workplanes just like parts and assemblies. The workplane position options are similar, with some specific methods just for workplanes.
To move a workplane,
1. Click Structure and then, in the Workplane group, click the arrow next to Position.
2. Click Position. The Position Wp dialog opens.
3. Select the workplane(s) in the viewport or Structure Browser.
4. Select a method to position the workplane:
◦ Dyn Pos: Use the 3D CoPilot in the viewport and enter values in the dialog as desired.
◦ Par to Face: Position the workplane parallel to a face. The Face Point is the point where the workplane's 0,0 coordinate is positioned.
◦ Par to WP: Position the workplane parallel to another workplane.
◦ Two Points: Select two points in the viewport. The first is the from point, and the second is the to point. The workplane is moved so the from point is positioned over the to point. If you enter a Length, the workplane is moved that distance from the first point toward the second point.
◦ Pt Dir: Moves the workplane based on a point and direction.
◦ On Axis: Aligns the
U, V, or W axis of the workplane with the face you select.
◦ Other: Special positioning commands that you might find useful in certain conditions. Most of the commands are the same in
Position a part or assembly, except the following:
▪ By global origin (World Origin),
Select World Origin. Creo Elements/Direct Modeling automatically positions the workplane using the global coordinate origin as the workplane's origin, the global X axis as the workplane's U axis, the global Y axis as the workplane's V axis, and the global Z axis as the workplane's W axis.
▪ Normal to another workplane (Norm to WP),
1. Select Norm to WP.
2. Click Ref WP and select the workplane to be normal to in the viewport or Structure Browser.
3. Click Origin and click on an origin point in the viewport.
4. Click Normal and set the normal direction in the viewport.
▪ By three points (Pt Pt Pt),
1. Select Pt Pt Pt.
2. Specify three points:
▪ The first point defines the new origin of the workplane.
▪ The second point defines an imaginary line (from point 1 to point 2). The U axis lies on this line.
▪ The third point defines an imaginary surface (points 1, 2, and 3). The V axis lies on this surface.
▪ On a clipping plane (On Clipping Plane),
1. Select On Clipping Plane.
2. Click on the clip plane you want to use in the viewport.
5. Some of the following options will be available, depending on the method you choose:
◦ Rel. Length: The distance relative to the workplane's current position.
◦ Rel. Rot. Ang: The angle of rotation relative to the workplane's current position.
◦ Fix Dir/Axis: The fixed direction or axis. Only active when the Line/Axis, Plane, or Rotate methods are active.
◦ Ref. Focus: Changes the type of geometric elements you can select for a reference point.
◦ Values: Choose Relative or Absolute. Relative values are calculated from the workplane's current position. This is useful when you position the workplane in multiple steps. Absolute is calculated from the workplane's original position (before you started the Position command).
You can use the
Select tool to reposition a group of workplanes in one operation. Creo Elements/Direct Modeling will use the first selected workplane as the position workplane and move the corresponding workplanes relative to the position workplane.
Position.
to complete the operation.