Join Feature
The Join feature helps you to connect two intersecting walls in a sheet metal part. You can trim the non intersecting portions of the walls as well as add a bend and bend relief at the intersection. You can also control the location of the intersection in which the feature would be created.
The element tree for the Join feature is documented in the header file ProSmtJoinWalls.h and is shown in the following figure:
Figure 135. Element Tree for Join Feature
The following table describes the elements in the element tree for the Join feature.
Element ID | Data Type | Description | ||
|---|---|---|---|---|
PRO_E_FEATURE_TYPE | PRO_VALUE_TYPE_INT | Specifies the type of the sheet metal feature. The valid value for this element is PRO_FEAT_JOIN_WALLS. | ||
PRO_E_STD_FEATURE_NAME | PRO_VALUE_TYPE_WSTRING | Specifies the name for the sheet metal feature. The default value is JOIN_1. | ||
PRO_E_SMT_WALL_JOIN_TRIM | PRO_VALUE_TYPE_INT | Specifies an option for trimming the non intersecting geometry. The valid values for this element are defined in the enumerated type ProSmtJoinWallsTrimType and are as follows: • PRO_INTWLS_TRIM_OPEN_CUTS— Specifies the original intersecting walls without being trimmed. • PRO_INTWLS_TRIM_BNDR_EXTS— Specifies that the non intersection portions up to the intersection between the surfaces will be removed. • PRO_INTWLS_TRIM_BEND_LINE— Specifies that the non intersecting surfaces will be trimmed up to the bend. | ||
PRO_E_SMT_WALL_JOIN_EXTEND | PRO_VALUE_TYPE_INT | The valid values for this element are defined in the enumerated type ProSmtJoinWallsExtType and are as follows: • PRO_INTWLS_EXT_LINE_TO_INT — Extends the intersection line to the intersection area. • PRO_INTWLS_EXT_LINE_TO_ALL — Extends the intersection line to the intersection plane.
| ||
PRO_E_SMT_WALL_JOIN_REFS | Array | An array element of only two surfaces, that form a join feature set. | ||
PRO_E_SMT_WALL_JOIN_REFS_CMPND | Compound | This compound element defines the collection of geometry to be joined. | ||
PRO_E_SMT_WALL_JOIN_REFS_SRF | PRO_ELEM_TYPE_SELECT | Select the surfaces which are to be connected by the join feature. | ||
PRO_E_SMT_WALL_JOIN_FLIP | PRO_VALUE_TYPE_INT | This element flips the wall join direction. The selection point of each wall determines which side of the walls will be kept. | ||
PRO_E_SMT_FILLETS | Compound | This compound element defines the bend types of the sheet metal wall and the value of bend radius. | ||
PRO_E_SMT_FILLETS_SIDE | PRO_VALUE_TYPE_INT | Specifies the fillet side. The valid values for this element are defined in the enumerated type ProSmdRadType and are as follows: • PRO_BEND_RAD_OUTSIDE— Applies the bend radius to the outer surface of the bend. • PRO_BEND_RAD_INSIDE— Applies the bend radius to the inner surface of the bend. • PRO_BEND_RAD_PARAMETER— Applies the bend radius at the dimension location set by the SMT_DFLT_RADIUS_SIDE parameter in . | ||
PRO_E_SMT_FILLETS_VALUE | PRO_VALUE_TYPE_DOUBLE | Specifies the value of the bend radius. | ||
PRO_E_SMT_BEND_RELIEF | Compound | This compound element defines the bend relief at the edges. For more information see the section Bend Relief Elements. | ||
PRO_E_SMT_DEV_LEN_CALCULATION | Compound | This compound element defines the method used to calculate the Developed Length dimensions for bends. For more information see the section The Element Subtree for Length Calculation. | ||
PRO_E_SMT_WALL_JOIN_EXTEND_EDGES | PRO_ELEM_TYPE_SELECT | Select the extended edges to be connected by the join feature. | ||
PRO_E_SMT_WALL_JOIN_EXTEND_EDGES_OPT | PRO_VALUE_TYPE_INT | Specifies the method to extend the edges and is specified using the enumerated data type ProSmtJoinWallsEdgeExtType . The valid values are: • PRO_INTWLS_EXT_EDGE_ALONG=0, -extend along boundary edges. • PRO_INTWLS_EXT_EDGE_NORMAL=1, extend normal to selected edges. |