To Create an Attached Flat Wall
1. Click
Model >
Flat. The
Flat tab opens.
2. Select an attachment edge. The selected edge is displayed in the Placement collector. A rectangular wall is created by default.
3. To choose a different wall shape, select one from the Shape list.
4. Set the wall dimensions using one of the following actions:
◦ Click Shape. The Shape tab opens. Edit the wall dimensions using the Sketch window.
◦ Drag the handles to set the dimensions.
◦ Click a wall dimension and edit the value.
5. Set a bend angle for the attachment wall using one of the following actions:
◦ Select an angle from the Angle list.
◦ Type a value in the Angle box.
◦ Drag the handles to adjust the angle.
◦ Double-click an angle value and type a new one.
6. To add a bend to the attachment edge, click
.
7. Set the value for the bend radius using one of the following actions:
◦ Select a value from the Bend Radius list.
◦ Drag the handles into position.
◦ Edit the value of the bend radius.
8. Set the bend dimension location:
◦ Click
to dimension the radius from the outside surface of the wall.
◦ Click
to dimension the radius from the inside surface of the wall.
◦ Click
to dimension the radius according to the location controlled by the
SMT_DFLT_RADIUS_SIDE parameter.
9. To flip the
material thickness direction, click
.
10. To set the offset of the wall from the attachment edge, click Offset. The Offset tab opens. Select Offset wall with respect to attachment edge and an attachment option.
For By value, type a value in the box or drag the handle to extend the base of the wall or to trim the existing wall at the attachment edge.
11. To change the default rip relief, click Relief. The Relief tab opens.
◦ To define the same relief for both sides, make sure the Define each side separately check box is cleared and select a relief type to apply from the list.
For a Stretch relief, set the angle value and width. For Rectangular and Obround reliefs, set values for the depth, length, and width.
◦ To define the relief differently for each side, perform the following tasks:
1. Select the Define each side separately check box.
2. Click Side 1 or Side 2.
3. Select a relief type to apply from the list.
For a Stretch relief, set the angle value and width. For Rectangular and Obround reliefs, set values for the depth, length, and width.
4. Set relief for the other side.
12. To set feature-specific bend allowance and calculate the developed length using a different method from that of the part, perform the following operations:
a. Click Bend Allowance. The Bend Allowance tab opens.
b. Click Use feature settings.
c. Perform one of the following operations:
▪ Click By K factor or By Y factor and type a new factor value or select one from the list.
▪ To use a bend table to calculate developed length for arcs, click By bend table. Use the default table, select a new one from the list, or click Browse to browse to a different table.
13. Click
.