Part Modeling > Engineering Features > Hole > Standard Holes > To Create a Tapped Hole
  
To Create a Tapped Hole
1. Click Model > Hole. The Hole tab opens with the default hole type set to Simple hole, and the default Placement Type set to Linear.
2. Click to change the hole type to Standard hole. The Standard hole options are shown. is selected by default.
3. Select a surface on the model where you want to place the hole. The selection is highlighted. This is your placement reference.
 
* You can also select the placement reference before you activate the hole tool.
4. To change the hole placement type select a new type from the placement Type box on the Placement tab.
5. Drag the offset placement reference handles to the appropriate references to constrain the hole. As you drag each handle, the available references are highlighted as your pointer moves over them. The system automatically snaps the handle to the reference and adds them to the Offset References collector on the Placement tab.
6. To orient the hole to be parallel to or perpendicular to a reference:
a. Click the Placement tab, click the Hole orientation collector, and select a planar, axial, or linear reference.
b. Select either Parallel or Perpendicular from the list.
7. Select the desired hole chart in the box adjacent to (Thread Type). Thread Type enables you to select industry-standard hole charts (ISO, UNC, or UNF for cylindrical tapped holes).
8. Type or select a screw size in the box adjacent to .
 
* If you enter a screw size that is not listed, The system selects the closest screw size. You can also drag the hole diameter handle to select a screw size.
9. To define the hole depth, select a depth option from the Depth Options list, or drag the depth handle in the graphics window.
 
* To define a new depth by dragging the depth handle, or by typing or selecting a new value, you must select the Blind depth option.
10. To specify the depth, select an option, and then type a value in the adjacent box:
◦ —Shoulder depth
◦ —Hole depth
11. To add countersink to your hole, click .
12. To define the countersink diameter or angle, click the Shape tab and type or select a new countersink diameter or countersink angle in the corresponding boxes.
13. To add counterbore to your hole, click .
14. To define the counterbore diameter or depth, click the Shape tab and type or select a new counterbore diameter or counterbore depth in the corresponding boxes.
15. To ensure that the entire top of the hole intersects the outside of the solid geometry, on the Shape tab, make sure that the Top Clearance check box is selected.
16. Click .