Part Modeling > Engineering Features > Hole > Standard Holes > To Create a Standard Hole
  
To Create a Standard Hole
1. Select the approximate hole location on the model. This is your primary placement reference. The selection is highlighted.
2. Click Model > Hole. The Hole tab opens and preview geometry of the hole is displayed.
3. Click to create a Standard hole. The Standard hole options are shown.
4. To relocate the hole, drag the primary placement handle to the new location or snap it to a reference.
5. To change the hole placement type select a new type from the placement Type box on the Placement tab.
6. Drag the offset placement reference handles to the appropriate references to constrain the hole. As you drag each handle, the available references are highlighted as your pointer moves over them. This enables you to target the correct reference. The system automatically snaps the handle to the reference and adds them to the Offset References collector on the Placement tab.
7. To align the hole with an offset reference, select the reference from the Offset References collector on the Placement tab and change Offset to Align.
 
* You can change the reference type only for holes that use the Linear placement type.
8. To orient the hole to be parallel to or perpendicular to a reference:
a. Click the Placement tab, click the Hole orientation collector, and select a planar, axial, or linear reference.
b. Select either Parallel or Perpendicular from the list.
9. To create a tapped hole, select .
10. To create a tapered hole, select .
 
* Tapped and Tapered holes are available only if is selected.
11. To create a clearance hole, click to deselect it and then click .
12. To create a drilled hole, click to deselect it and click .
13. Select the desired hole chart in the box adjacent to (Thread Type) on the Hole tab. Thread Type enables you to select industry-standard hole charts (ISO, ISO_7/1, NPT, NPTF, UNC, or UNF).
14. Type or select a screw size in the box adjacent to .
 
* If you enter a screw size that is not listed, the system selects the closest screw size. You can also drag the hole diameter handle to select a screw size.
15. To define the hole depth, select a depth option from the Depth Options list, or drag the depth handle in the graphics window.
 
* To define a new depth by dragging the depth handle, or by typing or selecting a new value, you must select the Blind depth option. The following depth options are available:
Blind—Drills the hole from the placement reference to a specified depth. This is the default option.
To Next—Drills the hole up to the next surface of a solid. That this option is not available in Assembly.
Through All—Drills the hole to intersect with all surfaces.
Through Until—Drills the hole to intersect with the selected surface. The Depth Reference collectors activate on the Hole tab and on the Shape tab. This depth option is not available in Assembly.
To Selected—Drills the hole to the selected quilt. The Depth Reference collectors activate on the Hole tab and on the Shape tab.
16. To add countersink to your hole, click on the Hole tab.
17. To define the countersink diameter or angle, click the Shape tab and type or select a new countersink diameter or countersink angle in the corresponding boxes.
18. To add counterbore to your hole, click on the Hole tab.
19. To define the counterbore diameter or depth, click the Shape tab and type or select a new counterbore diameter or counterbore depth in the corresponding boxes.
20. To ensure that the entire top of the hole intersects the outside of the solid geometry, on the Shape tab, make sure that the Top Clearance check box is selected.
21. Click .