Configuration Options for Part Modeling
accuracy_lower_bound
value (from 1.0e-6 to 1.0e-4)
Enter an accuracy value to override the default lower limit of 0.0001. The upper limit is fixed at 0.01.
allow_anatomic_features
yes, no*
yes—Makes the following commands available on the All Commands list:
• Local Push
• Radius Dome
• Section Dome
• Ear
• Lip
• Slot
• Shaft
• Flange
• Neck
Setting this configuration option to yes also makes Evaluate available when you click Insert > Model Datum.
allow_move_view_with_move
yes, no*
Disallows the movement of drawing views with the mouse.
allow_save_failed_model
yes, no, prompt*
Specifies whether failed models or models with failed features can be saved.
prompt—A warning is issued during the Save operation. You can continue saving or cancel the operation.
allow_udf_style_cosm_threads
yes, no*
Defines the Cosmetic Thread user interface.
yes—Creates a cosmetic thread as a UDF.
no—Creates a cosmetic thread as a Cosmetic Thread feature.
angle_grid_interval
1.000000*
Set angle_grid_interval when you want to modify grid space in angular units for handle movement.
auto_add_remove
yes*, no
Activates automatic toggling between add or remove material based on geometry analysis. Applies to solid extrude and solid revolve features during feature creation, but it does not apply to editing the definition of a previously created feature. Automatic toggling stops when add or remove material is changed manually.
yes—Add or remove material is set automatically.
no—Add or remove material is not set automatically. You must click
Remove Material to remove material.
autohide_copied_group_af
yes*, no
When set to yes, any annotation feature that is contained in the copied group, is hidden in the new group. In the new group, the Annotation Feature will not be visible in the graphics window.
autohide_external_sketch
yes*, no
yes—Automatically hides a sketch feature after it is used as the external sketch for a sketch based feature.
autoround_max_n_chains_per_feat
value (1 through 10, 5*)
Specifies the maximum number of edge chains that each Auto Round Member (ARM) of an Auto Round feature can contain.
backup_reference_information
yes*, no
Backs up the reference information of a feature when the feature regenerates.
blended_transparency
independent*, yes, no
independent—Gives a high-quality, order-independent transparent effect to the model. The effect is produced from hardware-accelerated graphics cards.
yes—Transparent colors appear using alpha blending when the model is shaded only when the graphics configuration (graphics card and Creo Parametric graphics setting) supports it.
centimeter_grid_interval
value, 0.100000
Set centimeter_grid_interval when you want to modify grid space in centimeter units for handle movement.
cosmetic_thread_match_tolerance
value, 0.025mm*, 0.001 inch*
Sets the tolerance that is used by the analysis to match standard thread type and standard radius to the selected thread surface.
create_fraction_dim
no*, yes
no—All dimensions created will be displayed as decimals.
yes—All dimensions created will be displayed as fractions.
datum_point_symbol
cross*, dot (filled), circle, triangle, square
Modifies the display of datum point symbols in Part or Assembly mode.
default_abs_accuracy
value
Defines the default absolute part accuracy.
default_dec_places
value, 2* for non-angular dimensions
Sets the default number of decimal places (0-14) to be displayed in all model modes for non-angular dimensions. It does not affect the displayed number of digits of dimensions as modified using Num Digits.
default_dep_copy_option
dep_dim*, full_dep
Sets the default option for Dependent copy in the Paste Special dialog box and on the Mirror tab. The two options are mutually exclusive.
dep_dim—Sets Partially dependent - Dimensions and AE Details only as the default for Dependent copy. This option creates copies of the original feature that are only dependent on the dimensions or the sketch, or both, or the annotation elements.
full_dep—Sets Fully dependent with options to vary as the default for Dependent copy. This option creates copies of the original feature that are fully dependent on all elements and attributes of the original feature. With this option, you can vary the dependency of certain feature elements and attributes of the copied features, such as dimensions, sketches, annotations, references, and parameters.
default_hole_top_clearance
auto*, yes, no
Sets the default state of the Top Clearance check box of the Hole feature. Applies to creating a new hole, but not to editing the definition of an existing hole.
auto*—The Top Clearance state is automatically determined based on the placement references. Once you change the check box manually, the automatic setting no longer applies to the current hole.
yes—Top Clearance is selected by default.
no—Top Clearance is cleared by default.
dim_fraction_denominator
value, 1/32*
Sets the largest denominator to be used for fractional dimensions. If the fraction can be reduced, then it converts to the lowest possible denominator (for example, 4/32 converts to 1/8). The denominator can be written either directly, for example, 32, or as a reciprocal, for example 1/32.
Available settings:
• 0
• 1/2
• 1/4
• 1/8
• 1/16
• 1/32*
• 1/64
• 1/128
display_all_dims
yes*, no
yes—The dimensions are displayed. If display_all_dims is set to yes and display_sketch_dims is set to no, then only non-Sketcher dimensions of the feature being edited are shown.
no—The dimensions are not displayed. If display_all_dims is set to no, then all dimensions of the feature being edited are not shown, including Sketcher dimensions, even if display_sketch_dims is set to yes.
display_coordinate_sys
yes*, no
Sets the default for displaying or not displaying the coordinate systems.
yes—Coordinate systems display.
no—Coordinate systems do not display.
display_draggers
yes*, no
Controls whether draggers are displayed in Edit mode.
yes—Draggers are displayed and enabled.
no—Draggers are not displayed, but you can drag entities.
display_dwg_sketch_constraint
yes, no*
yes—Parametric sketching constraints, such as V for vertical, are displayed when a drawing object is selected.
display_lattices_in_hq
yes*, no
yes—Improves the quality of the shaded display of simplified lattice representations.
no—Does not improve the quality of the shaded display of simplified lattice representations.
display_sketch_dims
yes*, no
Controls whether the sketch dimensions of a feature being edited are displayed in Edit mode.
yes—The sketch dimensions are displayed. If display_all_dims is set to yes and display_sketch_dims is set to no, then only non-Sketcher dimensions of the feature being edited are shown.
no—The sketch dimensions are not displayed. If display_all_dims is set to no, then all dimensions of the feature being edited are not shown, including Sketcher dimensions, even if display_sketch_dims is set to yes.
display_thick_lattices
yes*, no
yes—Displays beams of simplified lattices in shaded display style.
no—Does not display beams of simplified lattices in shaded display style.
dm_cache_mode
none, modified, all*
Indicates which objects are written to local cache when objects in Creo memory are saved.
dm_cache_size
value, 4000*
Enter the amount of disk space (in megabytes) to allocate for local file storage.
dm_remember_server
yes*, no
yes—You must set primary server and/or workspace for each Creo session.
dm_upload_objects
automatic, periodically, explicit*
Indicates when modified Creo objects are moved from the local cache to the user workspace on the server.
draft_preserve_inlying_rounds
yes, no*
Determines whether inlying round surfaces will be preserved or drafted.
yes—Inlying round surfaces will be preserved, and not drafted.
no—Inlying round surfaces will be drafted.
draft_tan_propagation_default
yes*, no
Determines if a draft is automatically propagated along tangent surfaces.
yes—Draft is automatically propagated along tangent surfaces.
no—Draft is not automatically propagated along tangent surfaces.
drilled_hole_tip_angle
value, 118*
Sets the default value of the tip angle of drilled holes. Enter a value from 60 through 180 degrees.
enable_absolute_accuracy
yes, no*
Controls the display of the ACCURACY menu, from which you can choose Relative Accuracy or Absolute Accuracy.
yes—The ACCURACY menu always appears when you choose Accuracy from the PART SETUP menu.
no—The menu appears only if the part is currently defined with absolute accuracy.
enable_auto_regen
yes*, no
Controls whether a model is automatically regenerated when you edit entities or dimensions in Edit mode.
yes—The model is automatically regenerated.
no—You must manually regenerate the model after edits.
enable_obsoleted_features
yes, no*
yes—Enables the following commands on the All Commands:
• Blend Between Surfaces
• Blend Section to Surfaces
• Conic Surface and N-sided Patch
• General Blend
• Pipe
• Project Section Blend
• Solid Free Form
• Surface Free Form
enable_tapered_extrude
yes*, no
Enables you to add a taper to an extrude feature by displaying the Add taper check box and the taper degree value box on the Extrude tab Options tab.
yes—The Add taper check box is displayed.
no—The Add taper check box is not displayed.
fail_unattached_feature
yes, no*
yes—When a part is retrieved, the system fails an unattached protrusion or cut.
no—When a part is retrieved, the system does not fail an unattached protrusion or cut.
feature_create_auto_begin
yes, no*
In feature creation, determines whether or not Define is automatically activated when you open the dialog box.
yes—Button is activated automatically.
no—You must click Define.
feature_create_auto_ok
yes, no*
In feature creation, determines whether or not the system activates OK automatically when the last required element is defined.
yes—Button is automatically activated.
no—You must click OK.
feature_type_default
solid*, surface, advanced
Sets the default for whether solid or surface is selected each time a tool is opened. This option applies to features that contain
and
buttons that toggle between solid and surface on their feature tab.
solid—Sets the default type to solid.
surface—Sets the default type to surface.
advanced—Sets the default type for extrude and revolve features to solid. Sets the default type for all other features to surface.
flip_arrow_scale
value, 1.000000*
Sets a scale factor for enlarging the size of the flip arrow that appears for feature creation direction.
foot_grid_interval
value, 0.083333*
Set foot_grid_interval when you want to modify grid space in foot units for handle movement.
group_repl_with_recycle
yes*, no
Controls the method of UDF replacement.
yes—Removes the group to be replaced from the model and performs group member replacement. When the group is replaced by a Family Table instance, the children of the old group are automatically mapped to the replacement Family Table instance.
no—Suppresses the group to be replaced, and then places the replacement group using the same references.
group_replace_rename
yes*, no
Controls the renaming of replaced groups.
yes—Changes the existing group name to that of the new group.
no—Preserves the existing group name, if it is a user-defined name.
hole_diameter_override
yes, no*
yes—On the Hole tab, you can change the diameter of a suggested default diameter for standard tapped and clearance holes. Set this toyes if you are familiar with available drills and need to change the system default value.
no—A diameter value (based on the table lookup function) is displayed, and the value is grayed out so you cannot change it.
hole_file_resolution
use_internal, replace_with_external*
use_internal—Embeds the hole file with the part model.
replace_with_external—Refers to the external hole file instead of the embedded hole file for the part model.
hole_parameter_file_path
fastener_directory
Enables you to use a local hole table instead of the system hole table.
inch_grid_interval
value, 0.03125*
Set inch_grid_interval when you want to modify grid space in inch units for handle movement.
info_output_format
text, html*
Sets up the default format type for information output.
text—Information output is text.
html—Information output is html.
keep_info_datums
yes*, no
Sets the initial state of how the system treats datums and features created at run time.
lattice_points_in_simulate_only
yes*, no
yes—Displays lattice open boundary point sets only in Simulation mode.
no—Displays lattice open boundary point sets all the time.
mark_approximate_dims
yes, no*
yes—Displays a tilde (~) in front of a dimension if that dimension:
• Is set to display as a fraction
• Has an actual value that has not been rounded to equate exactly to the displayed fractional value (in other words, the fraction shows 7/32 but the actual value is .22, not 0.21875)
|  The second case is a general case that does not always require a relation in order to occur. |
merge_type
intersect*, join
Sets the default surface merge type.
intersect—Sets the default surface merge type to intersect.
join—Sets the default surface merge type to join.
meter_grid_interval
value, 0.001000*
Set meter_grid_interval when you want to modify grid space in meter units for handle movement.
millimeter_grid_interval
value, 0.1*
Set millimeter_grid_interval when you want to modify grid space in millimeter units for handle movement.
new_parameter_ui
yes*, no
Enables the Creo parameter editor and user interface.
new_relation_ui
yes*, no
Enables the Creo relations editor and user interface.
part_table_editor
protab*, excel, editor
Sets the editor used to edit table parameters.
protab—Sets the editor to Pro/TABLE.
excel—Sets the editor to Microsoft Excel.
editor—Sets the editor defined in the
pro_editor_command configuration option.
pro_editor_command
<path to executable file>
Sets the path of an external editor. Type the path of the editor to use for the
editor value of the
part_table_editor configuration option.
pro_group_dir
<directory name>
Sets the default directory for the user-defined feature (UDF) library. If not specified, your current working directory is the default. Use the full path name to avoid problems. For example, /home/users/library/groups.
ratio_grid_interval
value, 0.050000*
Set ratio_grid_interval when you want to modify grid space in percentage units for handle movement.
regen_failure_handling
resolve_mode, no_resolve_mode*
Sets the mode for resolving regeneration failures when they occur.
regenerate_read_only_objects
yes*, no
Determines whether an object from a Pro/INTRALINK database with blocking status can be regenerated in a Creo session.
select_on_dtm_edges
all_modes*, sketcher_only
A datum plane can be selected by clicking its visual boundary. If you have to select frequently, you might want to set this option to sketcher_only so that the selection mode is active only in Sketcher.
show_axes_for_extr_arcs
yes, no*
Determines if axes are created for newly extruded arcs.
show_dim_sign
yes, no*
Shows negative or positive values for dimensions.
yes—If the dimension you modify is negative, and if you enter a negative value, the system creates the geometry to the same side (with the exception of dimensions created with respect to coordinate systems and datum point offsets—these dimensions display the negative/positive value even if this option is set to no).
no—Dimension values appear positive; if you enter a negative value, the system creates the geometry to the opposite side.
show_geom_checks_on_creation
yes, no*
yes—The SHOW ERRORS menu appears at the end of feature creation when the feature has geometry checks.
system_curves_color
Specifies the default color of curve entities. The three decimal values specify (in order) a percentage of red, green and blue in the resulting color. For example, 0 0 49 specifies a medium blue.
troubleshooter_show_info_gcheck
yes, no*
Display information related to the edges or chains of edges that are not rounded and that are within the scope of the Auto Round feature in the
Troubleshooter dialog box that is opened by clicking
Tools >
Geometry Checks.
yes—Displays the Show info items command in the View menu.
no—Removes the Show info items command from the View menu.
use_nom_dim_val_in_expr
yes, no*
Uses either a dimension’s current values or nominal values in an expression.
yes—Use the dimension’s nominal values.
no—Use the dimension’s current values.
This configuration option affects the dimension value under the following conditions:
• In a relation expression that contains a shrinkage dimension
• Shrinkage is calculated by dimension
• Shrinkage factor is applied before the evaluation of relations
• The use_nom_dim_val_in_expr configuration option is set to no
use_pre_wildfire_text_font
yes, no*
yes—Use the old stroke-based PTC font as the default font.
no—Use a True Type font as the default font.
user_defined_grid_interval
value, 0.500000*
Set user_defined_grid_interval when you want to modify grid space in user defined length units for handle movement.
web_browser_homepage
Enter the location of the Creo browser home page.
web_enable_javascript
on, off*
on—Enable the Javascript API for Creo.
off—Disable the Javascript API for Creo.