To Define Varied Features in an Inheritance Feature

Assembly Design > Top Down Design > Data Sharing > Merge and Inheritance Features > Inheritance Features > To Define Varied Features in an Inheritance Feature

1. Retrieve an assembly, select a part in it, right-click, and choose Activate.

2. Select a second part in the assembly as the reference model from which geometry will be copied and click Get Data > Merge/Inheritance. The Merge/Inheritance tab opens with the reference model selected by default. You can select a different part as the reference model from the Model Tree or in the graphics window.

3. Click

Merge/Inheritance to toggle between Merge mode (default) and Inheritance mode.

4. Click Options.

5. Click Varied Items. The Varied Items dialog box and a separate window showing the Inheritance model open.

6. Click the Features tab and select a feature of the Inheritance model. The selected feature is highlighted in the model and added to the features list in the Varied Items dialog box.

7. To remove a dimension, select it from the list and click

. To add dimensions, click

and select other features of the Inheritance model.

8. To suppress, resume, or erase a feature, select a feature from the list and choose one of the following value limits from the New Status list:

◦ Resumed (default)

◦ Suppressed

◦ Erased

9. Click OK.

To redefine the varied features, right-click the Inheritance feature in the Model Tree, and select Varied Items from the shortcut menu. The Varied Items dialog box opens.