Part Modeling > Part Modeling > Engineering Features > Draft > Split Draft > Example: Creating a Split Draft
Example: Creating a Split Draft
This example shows creating a Split Draft feature. The original part is shown in the following illustration. It consists of a solid extruded feature, created symmetrically on both sides of the TOP datum plane, with rounds on all the vertical side edges.
1. Click Model > Draft. The Draft tab opens.
2. Select any side surface. Because all the side surfaces are tangent to each other, the draft automatically extends to all the surfaces around the part.
3. Click the Draft hinges collector to activate it and select the TOP datum plane as the draft hinge. Note that this datum plane is exactly in the middle of the part, because the extruded solid feature has been created symmetrically on both sides of the sketching plane. The system automatically uses this plane to determine the pull direction as well, and displays the preview geometry.
4. Open the Split tab and select Split by draft hinge from the Split options menu.
5. Select Draft sides dependently from the Side options menu.
6. Type 10 in the Angle 1 box to add or remove material. To change the draft side, click reverse angle to the right of the Angle 1 box The system updates the preview geometry, as shown in the next illustration.
7. Click OK to create the Draft feature. The final geometry is shown in the following illustration.