To Create a Parallel Blend by Sketching the Sections
1. Click > > 
Blend. The Blend tab opens.
Blend. The Blend tab opens.2. Click 
Solid to create a solid feature, or click 
Surface to create a surface feature.
Solid to create a solid feature, or click Surface to create a surface feature.3. To use an internal or external sketch as the first section, click 
Sketched Sections, or select Sketched sections on the Sections tab.
Sketched Sections, or select Sketched sections on the Sections tab.4. Create the first section by performing one of the following procedures:
◦ Sketch an internal section:
1. Click the Sections tab, and click Define next to the Sketch collector. The Sketch dialog box opens.
2. To define the sketch plane for the first section, select a planar surface or datum plane. Define the section orientation, and click Sketch. The Sketch tab opens.
3. Sketch the first section, and click 
OK. The Sketch tab closes.
OK. The Sketch tab closes.◦ Select a sketched datum curve.
5. To create another section:
 | If the first section is an internal or external sketch, the rest of the sections in the blend must be internal sketches. |
a. Click the Sections tab, and click Insert.
b. To define the sketch plane for the section, perform one of the following actions:
▪ To offset from another section in the blend:
1. Select 
on the Blend tab, or select Offset dimension on the Sections tab.
on the Blend tab, or select Offset dimension on the Sections tab.2. Select the section from which to offset the new section in the list on the Blend tab or in the Offset from list on the Sections tab.
3. Type an offset value next to the selected section.
▪ To select a reference to define the sketch plane:
1. Select 
on the Blend tab, or select Reference on the Sections tab.
on the Blend tab, or select Reference on the Sections tab.2. Select a planar reference, a point, a vertex, or the end of a curve.
c. Click Sketch and create the section. Click OK to close the Sketch tab.
OK to close the Sketch tab.6. If required, sketch more sections by repeating the previous step.
7. To remove material along the blend, click 
Remove Material, and then perform actions depending on whether the blend is a solid or surface feature:
Remove Material, and then perform actions depending on whether the blend is a solid or surface feature:◦ Solid
Solid▪ Optionally, click 
to flip the side of the sketch from which material is removed.
to flip the side of the sketch from which material is removed.◦ Surface
Surface1. Click the Quilt collector, and then select a quilt to trim.
2. To change the portion of the quilt to be removed, click 
to the right of Remove Material. Switch between three modes:
to the right of Remove Material. Switch between three modes:▪ Remove side 1
▪ Remove side 2
▪ Keep both sides
8. If you keep both sides of the quilt, to select the side that will inherit the original quilt ID, click to the right of the Quilt collector.
to the right of the Quilt collector.9. To add thickness to the section, click 
Thicken Sketch, and type a thickness value. Click to toggle the thicken direction to one side, the other side, or both sides of the sketch.
Thicken Sketch, and type a thickness value. Click to toggle the thicken direction to one side, the other side, or both sides of the sketch.10. Click the Options tab, and select Straight to connect the blend sections with straight lines and connect the edges of the sections with ruled surfaces, or Smooth to create smooth lines and connect the edges of the sections with spline surfaces.
11. Click the Tangency tab, and select a tangency condition for each start and end section.
12. For a Solid feature, click the Body Options tab, and then select the body to which to add geometry, or from which to remove geometry:
Solid feature, click the Body Options tab, and then select the body to which to add geometry, or from which to remove geometry:◦ Add geometry
▪ To add geometry to an existing body, click the body collector, and then select the body to which geometry is added.
▪ To create the feature in a new body, select the Create new body check box. The name of the new body appears in the body collector.
◦ Remove geometry
▪ To cut geometry from all the bodies that the feature passes through, select All.
▪ To cut geometry from selected bodies:
1. Select Selected.
2. Click the body collector, and then select bodies from which to cut geometry.
13. Click 
OK.
OK.