Part Modeling > Part Modeling > Base Features > Blends > Parallel Blends > To Create a Parallel Blend by Selecting the Sections
To Create a Parallel Blend by Selecting the Sections
1. Click Model > Shapes > Blend. The Blend tab opens.
2. Click Solid to create a solid feature, or click Surface to create a surface feature.
3. To select chains to use as the first section, click Selected Sections, or select Selected sections on the Sections tab.
4. Click the Sections tab, and do the following:
a. Select chains to define the first section. Optionally, click Details to open the Chain dialog box to select chains.
b. To create another section, on the Sections tab, click Insert, click Details to open the Chain dialog box, select chains, and click OK.
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If the first section is defined using selected chains, the rest of the sections in the blend must also be selected.
c. If required, select more sections by repeating the previous step.
5. To remove material along the blend, click Remove Material, and then perform actions depending on whether the blend is a solid or surface feature:
Solid
Optionally, click to flip the side of the sketch from which material is removed.
Surface
1. Click the Quilt collector, and then select a quilt to trim.
2. To change the portion of the quilt to be removed, click to the right of Remove Material. Switch between three modes:
Remove side 1
Remove side 2
Keep both sides
6. If you keep both sides of the quilt, to select the side that will inherit the original quilt ID, click to the right of the Quilt collector.
7. Click the Options tab, and select Straight to connect the blend sections with straight lines and connect the edges of the sections with ruled surfaces, or Smooth to create smooth lines and connect the edges of the sections with spline surfaces.
8. Click the Tangency tab, and select a tangency condition for each start and end section.
9. For a Solid feature, click the Body Options tab, and then select the body to which to add geometry, or from which to remove geometry:
Add geometry
To add geometry to an existing body, click the body collector, and then select the body to which geometry is added.
To create the feature in a new body, select the Create new body check box. The name of the new body appears in the body collector.
Remove geometry
To cut geometry from all the bodies that the feature passes through, select All.
To cut geometry from selected bodies:
1. Select Selected.
2. Click the body collector, and then select bodies from which to cut geometry.
10. Click OK.