To Create a Parameter
1. Click Tools > Parameters. The Parameters dialog box opens.
2. Under Look In, select the desired object type to which you want to add a parameter.
3. Click and select the object from the Model Tree or graphics window.
4. Click and type a new parameter name in the Name column.
Parameter names cannot contain nonalphanumeric characters such as !, ", @, and #.
5. Under Type, select the type of parameter as Integer, Real Number, String, or Yes No.
6. Specify the value of the selected parameter in the Value box.
7. Optionally, select the Designate box to make the parameter visible in the PDM system such as Pro/INTRALINK or Windchill.
You can also designate body level, feature level, or geometry level parameters in a part. When you assemble a part with designated parameters in an assembly, the designated parameters are listed in the assembly BOM if you have configured the BOM to show the designated objects.
8. Under Access, specify access to the parameter as Full, Limited, or Locked.
The Source cell reflects the origin of the parameter, for example, User-Defined.
9. Optionally, add a note about the parameter under Description.
10. Click OK.
You can use Parameters on the shortcut menu to edit single as well as multiple items. If you select multiple objects on the Model Tree, the first selected node determines the type of object to which the parameter is added. For example, if the first selected node is a model then the parameters are added to the models. If the first selected node is a feature, then the parameters are added to the components.
If you have included a parameter in a Family Table, layout note, or relation, then you can also modify the parameter by editing that Family Table, note, or relation.