About Automatically Showing Detail Items Upon View Creation
In a drawing view, you can automatically display the annotations attached to a model in 3D mode by setting the auto_show_3d_detail_items configuration option to yes. A detail item must also fulfill the following conditions to be displayed automatically:
• All items must have annotation planes.
• The item's annotation plane must be parallel to the view orientation.
• The item's viewing direction must match the viewing direction of the drawing.
• The item's attachment references must be available in the view. In case of on entity and leader references, the attachment types are available in the view.
If these conditions are met, the following detail items are automatically shown upon view creation:
• Notes
• Geometric Tolerances
• Surface finishes
• Symbols
• Driven dimensions
• Driving Dimensions Annotation Elements
• Reference dimensions
• Model Set Datum Annotation Elements
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The Set Datum Annotation Elements, except the Set Datum Annotation Elements placed on the geometry, need not fulfill all the conditions required for automatic display in the view. Model set datum planes are displayed in all the views where the set datum plane is perpendicular to the view orientation regardless of the value of the auto_show_3d_detail_items configuration option.
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• Model set datum axes
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Model set datum axis annotations need not fulfill all the above conditions to be displayed in the view. Model set datum axes are displayed in all the views where the annotation tag plane is parallel to the view plane and the auto_show_3d_detail_items configuration option is set to yes.
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• Model set datum planes
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• Model set datum planes need not fulfill all the above conditions to be displayed in the view. Model set datum planes are displayed in all the views where the datum plane is perpendicular to the view orientation regardless of the value of the auto_show_3d_detail_items configuration option.
• The Model Set Datum Annotation Elements placed on the geometry must fulfill all the conditions required for automatic display on view creation.
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• "Free" placed detail items. These are displayed automatically if they meet the conditions for parallelism and viewing direction.
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• Driving dimensions that are not Annotation elements are not displayed on annotation planes and are therefore, not automatically displayed.
• A diameter dimension on a curve or a cylindrical surface with annotation elements is displayed automatically in a view parallel to the annotation plane only if you have included the dimension in an annotation element. However, you can move the diameter dimension to another view parallel to the axis of the curve or the cylinder to display it automatically.
• You can automatically show detail items only on the creation of a new view. The detail items are not automatically shown in existing views in the drawing sheet or on modifying an existing view.
• On changing the view orientation, the automatically displayed detail items display behavior that is similar to items that have been inserted manually.
• For assembly and part simplified representations, only detail items whose references are available in the simplified representations and which fulfill the conditions required for automatic display are displayed upon view creation. For example, if all the references of a dimension are included in the simplified representation definition, and the dimension meets the conditions for automatic display, then the dimension is automatically shown. However, if all the references of the dimension are not included in the simplified representation, then the dimension is not shown.
• For process drawings, only detail items included in the represented step are automatically shown upon view creation.
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