You can use Creo Parametric functions to fix section profiles in AutobuildZ. You can close one or more open loops, divide intersecting entities, remove entities from section profiles, cut or extend entities to form one or more closed loops, and retain entities as part of the fix when section profile validation fails.

You can close single or multiple open loops. If the section profile consists of a single open loop, the end points of the open loop are joined by a straight line to form a single, valid closed loop.

If the section profile consists of multiple loops, and one or more of the loops are open, the end points of the open loops that are highlighted as yellow circles are joined and closed by straight lines. Each of the multiple open loops are closed. You can also form a single closed loop from all the multiple open loops.

You can trim (cut or extend) entities of the section profile that consists of multiple open loops. The Closed Loop and the Multiple Closed Loops validation checks report failure.

If you select the Closed Loop validation check and the Trim option, the entities are cut or extended to form a single closed loop.

If you select Multiple Closed Loops and the Trim option, entities are cut or extended combined to form one or more closed loops.

You can divide intersecting entities at the point of intersection as part of the section profile fix. Entities are created, and you may or may not retain the new entities.

The intersecting entities are replaced by the new entities on the drawing when you choose to retain the new entities.

If you choose not to retain the new entities on the drawing, the old entity is retained on the drawing while the new entities are temporarily added to the drawing. These new entities are deleted after feature creation or deleted when you define a new section profile for the same feature.

You can directly remove overlapping entities or remove entities from the group of entities that define the section profile as part of the section profile fix. Select entities to be removed from the group of entities that define the section profile on the drawing. The entities marked for removal are highlighted in the graphics window.

You can also select the section profile entities to be removed from a list. Click Remove under Section profile fix options in the Section Profile Validation dialog box to remove the entities from the list.

For revolved features, when entities are on both sides of the axis of revolution, you can retain entities on one of the sides of the axis of revolution.