To Add a Legacy Fastener

Assembly Design > Creo Intelligent Fastener > Using Creo Intelligent Fastener > Customizing Creo Intelligent Fastener > To Add a Legacy Fastener

1. Start Creo Parametric.

2. Click File > Options > Configuration Editor and set the configuration option, show_selected_item_id to yes. Click OK.

3. Open your legacy fastener.

4. In the graphics window, move the pointer over the placement axis of your fastener and note the ID.

5. In the graphics window, move the pointer over the placement surface of your fastener and note the ID.

6. Open the fastener data file where you want to add your fastener.

7. Add the ID pair to the placement reference keywords SURFACE and AXIS. Be sure to separate the values by pressing the TAB key.

8. Search for the size of your fastener in the instance list.

9. Rename the instance to the name of your legacy fastener.

In this example the legacy nut MY-ISO4032–M10.prt is added to the fastener instance data file ISO4032-6.dat. The placement reference IDs are 129 for the SURFACE and 34 for the AXIS.

NUTTYPE	1
UNIT	MM
SURFACE	9	129
AXIS	92	34
INFO	ISO 4032 - 6
CBNUT	DIN974-2 R1

SYMBOL	DN	S	E	K	DG	P	BUW_NAME	BUW_TYPE	BUW_SIZE
INSTANCE	DN	S	E	K	DG	P	name	type	size
ISO4032-M3-6	3	5.5	6	2.4	2.5	0.5	hexagonnut	ISO 4032	M3 — 6
...
ISO4032-M8-6	8	13	14.4	6.8	6.8	1.25	hexagonnut	ISO 4032	M8 — 6
MY-ISO4032–M10	10	16	17.8	8.4	8.5	1.5	hexagonnut	ISO 4032	M10 — 6
ISO4032-M12-6	12	18	20	10.8	10.2	1.75	hexagonnut	ISO 4032	M10 — 6
...