To Create an Attached Flat Wall
1. Click > 
Flat. The Flat tab opens.
Flat. The Flat tab opens.2. Click Placement and select an attachment edge. The selected edge is displayed in the collector.
A rectangular wall is created by default. To choose a different wall shape, select one from the Shape list.
3. Click Shape and set the wall dimensions using one of the following actions:
◦ Edit the wall dimensions using the Sketch window.
◦ Drag the handles to set the dimensions.
◦ Click a wall dimension and edit the value.
4. Set a bend angle for the attachment wall by using one of the following actions:
◦ Click the Angle list 
and select a bend angle value for the attachment wall.
and select a bend angle value for the attachment wall.Alternatively, you can type a value in the Angle box.
◦ Drag the handles to adjust the angle.
◦ Double-click an angle value and type a new one.
5. Click 
to flip the thickness from one side of the sketch plane to the other.
to flip the thickness from one side of the sketch plane to the other.6. Click 
to add a bend on the attachment edge. Select a thickness value from the list, and then select one of the options to apply a method for dimensioning the bend:
to add a bend on the attachment edge. Select a thickness value from the list, and then select one of the options to apply a method for dimensioning the bend:◦ Click 
to dimension the radius from the outside surface of the wall.
to dimension the radius from the outside surface of the wall.◦ Click 
to dimension the radius from the inside surface of the wall.
to dimension the radius from the inside surface of the wall.◦ Click 
to dimension the radius according to the location controlled by the SMT_DFLT_RADIUS_SIDE parameter.
to dimension the radius according to the location controlled by the SMT_DFLT_RADIUS_SIDE parameter.7. Click Bend Position and select one of the five types.
If you select 
Offset from Bend Start or 
Offset from Bend Apex, then type a value for the offset.
Offset from Bend Start or Offset from Bend Apex, then type a value for the offset.8. Click Relief and select Bend Relief or Corner Relief.
If you select Bend Relief:
◦ To define the same relief for both sides, make sure the Define each side separately check box is cleared and select a relief type to apply from the Type list.
◦ To define a different relief for each side, click the Define each side separately check box, select Side 1, and then select a relief type to apply from the Type list. Repeat for Side 2.
When defining a bend relief for both sides or separately:
▪ For a Stretch relief, set the angle value and width.
▪ For Rectangular and Obround reliefs, set values for the depth, length, and width.
If you select Corner Relief and Define corner relief:
◦ Clear the Create relief geometry check box if you want to define the corner but create the geometry using Unbend or Flat Pattern features.
◦ Select a relief Type, Origin, and Orientation option
9. To set feature-specific bend allowance and calculate the developed length using a different method from that of the part, perform the following operations:
a. Click Bend Allowance. The Bend Allowance tab opens.
b. Select Use feature settings.
c. Perform one of the following operations:
▪ Click By K factor or By Y factor and type a new factor value or select one from the list.
▪ To use a bend table to calculate developed length for arcs, click By bend table. Use the default table or select a new one from the list.
10. Click 
.
.Corner Treatment
The Corner Treatment tab is enabled only when your model contains two flat walls that meet at a corner.
To specify a corner treatment using the tab commands:
1. Select the second flat wall and click its Edit Definition. The Flat tab opens showing an enabled Corner Treatment tab.
2. Click Corner Treatment.
3. Select a geometry from the Geometry list.
4. Select a type from the Type list.
5. Optionally select the Narrow the corner check box.
To specify a corner treatment using the mini tool bar commands:
1. Select the second flat wall and click its Edit Definition. The Flat tab opens showing an enabled Corner Treatment tab.
2. Click the left mouse button over the graphics screen. A mini tool bar opens showing icons for the five bend position types in the top row. It also shows icons for 
Corner Geometry, Edit Seam, Edit Corner Relief, and Edit Bend Relief.
Corner Geometry, Edit Seam, Edit Corner Relief, and Edit Bend Relief.3. Click and select the type of geometry that you want to create.
and select the type of geometry that you want to create.To apply the selected corner treatment, click .
.