About the Revolve User Interface
The Revolve tab consists of commands, tabs, and shortcut menus. Click > 
Revolve to open the Revolve tab.
Revolve to open the Revolve tab.Commands
• 
Solid—Creates a solid feature.
Solid—Creates a solid feature.• 
Surface—Creates a surface feature.
Surface—Creates a surface feature.• 
collector—Displays the sketch that contains the axis of revolution.
collector—Displays the sketch that contains the axis of revolution.• Side 1 angle of revolution options:
◦ 
Variable—Revolves a section from the sketching plane by a specified angle value.
Variable—Revolves a section from the sketching plane by a specified angle value.▪ Angle value box—Sets the angle value for Side 1.
◦ 
Symmetric—Revolves a section on each side of the sketching plane by half of the specified angle value in each direction.
Symmetric—Revolves a section on each side of the sketching plane by half of the specified angle value in each direction.▪ Value box—Sets the angle value for Side 1.
◦ 
To Selected—Revolves a section to a selected point, plane, or surface.
To Selected—Revolves a section to a selected point, plane, or surface.▪ First direction angle reference collector—Displays the point, plane, or surface that defines the revolve angle.
• 
—Flips the revolve angle direction to the other side of the sketch.
—Flips the revolve angle direction to the other side of the sketch.• 
Remove Material—Removes material along the revolve to create a cut for a solid feature or a quilt trim for a surface feature.
Remove Material—Removes material along the revolve to create a cut for a solid feature or a quilt trim for a surface feature.◦ 
—Flips the remove functionality to remove material from the opposite side of the sketch.
—Flips the remove functionality to remove material from the opposite side of the sketch.• 
—Adds a thickness to a sketch to create a thin solid, a thin solid cut, or a thin surface trim.
—Adds a thickness to a sketch to create a thin solid, a thin solid cut, or a thin surface trim.◦ Value box—Sets a thickness value.
◦ —Switches the thicken direction to one side, the other side, or both sides of the sketch.
—Switches the thicken direction to one side, the other side, or both sides of the sketch.• Quilt collector—Displays a quilt to trim when Surface and Remove Material are selected.
Surface and Remove Material are selected.◦ (to the left of the Quilt collector)—Switches the side of the quilt to remove to one side, the other side, or keep both sides of the quilt.
(to the left of the Quilt collector)—Switches the side of the quilt to remove to one side, the other side, or keep both sides of the quilt.◦ (to the right of the Quilt collector)—Toggles the side of a quilt to retain the ID of the original quilt if you keep both sides of the quilt.
(to the right of the Quilt collector)—Toggles the side of a quilt to retain the ID of the original quilt if you keep both sides of the quilt.Tabs
• Placement
◦ Sketch collector—Displays the sketch that defines the revolve feature.
▪ Define—Opens Sketcher so you can create an internal sketch.
▪ Edit—Opens the internal sketch in Sketcher for editing.
▪ Unlink—Breaks the association with the selected sketch and copies the sketch as an internal sketch.
◦ Axis collector—Displays the axis of revolution.
▪ Internal CL—Uses the sketched centerline as the axis of revolution.
• Options
◦ Side 1 and Side 2—Sets the angle option on Side 1 or Side 2 of the reference.
▪ Value box—Sets an angle value when or is selected.
or is selected.▪ Reference collector—Displays a reference when is selected.
is selected.◦ Capped ends check box—Closes each end of a revolve feature when Surface is selected.
Surface is selected.◦ Section end point 1 and Section end point 2—Highlights the corresponding end point in the graphics window when you point to the label. Available when thicken sketch is selected, the sketch is open, one or both sketch end points intersect the model solid geometry, and at least one surface can be used for capping and attaching the revolve feature.
thicken sketch is selected, the sketch is open, one or both sketch end points intersect the model solid geometry, and at least one surface can be used for capping and attaching the revolve feature.▪ Cap with model geometry check box—Caps and attaches thickened revolved geometry to the model.
▪ Previous and Next—Switches between the surfaces that can be used to cap and attach the revolved geometry.
• Body Options
Available when the feature is created as a solid. Not available for creating assembly-level features.
◦ Add geometry to body—Displayed when geometry is added.
▪ Create new body check box—Creates the feature in a new body.
▪ Body collector
▪ Selects the body to which geometry is added when you add the feature to an existing body. The default body is displayed, unless you select a different body.
▪ Shows the name of the new body when you create the feature in a new body.
◦ Cut geometry from body—Displayed when geometry is removed.
▪ All—Cuts geometry from all the bodies that the feature passes through.
▪ Selected—Cuts geometry from the selected bodies. The default body is displayed, unless you select a different body or bodies.
▪ Body collector—Selects the body from which geometry is removed.
• Properties
◦ Name box—Sets a name for a revolve feature.
◦ 
—Displays detailed component information in a browser.
—Displays detailed component information in a browser.Shortcut Menus
Right-click the graphics window to access shortcut menu commands.
• Solid—Switches from surface geometry to solid.
Solid—Switches from surface geometry to solid.• Surface—Switches from solid geometry to surface.
Surface—Switches from solid geometry to surface.• Remove Material—Removes material along the revolve to create a cut for a solid feature or a quilt trim for a surface feature.
Remove Material—Removes material along the revolve to create a cut for a solid feature or a quilt trim for a surface feature.• Thicken Sketch—Adds a thickness to a sketch to create a thin solid, a thin solid cut, or a thin surface trim.
Thicken Sketch—Adds a thickness to a sketch to create a thin solid, a thin solid cut, or a thin surface trim.• Clear—Clears the active collector.
• Flip Angle Direction—Switches the direction of the feature creation to the other side of the sketching plane.
• Side 2—Toggles the Side 2 depth option on the Options tab.
• Flip Material Side—Switches the side of the sketch from which to remove material when creating a cut, or the side to which to add material when creating a protrusion.
• 
Define Internal Sketch—Opens Sketcher so you can create an internal sketch.
Define Internal Sketch—Opens Sketcher so you can create an internal sketch.• Edit Internal Sketch—Opens the internal sketch in Sketcher for editing.
Edit Internal Sketch—Opens the internal sketch in Sketcher for editing.• 
Internal CL—Uses the sketched centerline as the axis of revolution.
Internal CL—Uses the sketched centerline as the axis of revolution.• 
Capped Ends—Closes each end of a revolve feature when Surface is selected.
Capped Ends—Closes each end of a revolve feature when Surface is selected.• Select bodies—Activates the body collector so you can select bodies.
• Create new body—Creates the feature in a new body.
• All—Removes geometry from all the bodies that the feature passes through.
• Selected—Removes geometry from the selected bodies.
Right-click a revolve feature to access shortcut menu commands.
• Placement Collector—Activates the Sketch collector.
• Trim Quilt Collector—Activates the Quilt collector.
• Axis of Revolution Collector—Activates the Axis collector.
• Intersection Components Collector—Defines the feature visibility and select the components that the feature will intersect in Assembly mode.
• To Selected Angle1 Collector—Activates the Side 1 reference collector when the angle option is To Selected.
To Selected.• To Selected Angle2 Collector—Activates the Side 2 reference collector when the angle option is To Selected.
To Selected.Right-click a directional arrow to access shortcut menu commands.
• Flip—Switches the direction of feature creation.
Right-click a drag handle to access shortcut menu commands.
• Flip Angle Direction—Switches the direction of the feature creation in relation to the sketching plane.
• Variable—Sets the angle option to .
.• Symmetric—Sets the angle option to .
.• To Selected—Sets the angle option to .
.• Other Side—Sets the depth option on the other side of the sketching plane.