To Create a Standard Coaxial Hole
1. Click > 
Hole. The Hole tab opens.
Hole. The Hole tab opens.2. Select an axis on the model. This is your primary placement reference for the Coaxial hole. The selection is highlighted. The Coaxial placement type is selected on the Placement tab. The hole preview geometry is aligned to the selected axis.
3. Click 
Standard to create a standard hole. The standard hole options are shown.
Standard to create a standard hole. The standard hole options are shown.4. Click the Offset References collector on the Placement tab to activate it and select a surface or a datum plane as the offset reference to constrain the hole.
5. Select the desired hole chart in the box adjacent to 
Thread type on the Hole tab. Thread Type enables you to select industry-standard hole charts (ISO, UNC, or UNF).
Thread type on the Hole tab. Thread Type enables you to select industry-standard hole charts (ISO, UNC, or UNF).6. Type or select a screw size in the box adjacent to 
Screw size.
Screw size. | If you enter a screw size that is not listed, the system selects the closest screw size. You can also drag the hole diameter handle to select a screw size. |
7. To define the hole depth, select a depth option from the Depth Options list, or drag the depth handle in the graphics window.
8. To add countersink to the hole:
a. Click 
Countersink on the Hole tab.
Countersink on the Hole tab.b. To define the countersink diameter or angle, click the Shape tab and type or select a new countersink diameter or countersink angle in the corresponding boxes.
9. To add counterbore to the hole:
a. Click 
Counterbore on the Hole tab.
Counterbore on the Hole tab.b. To define the counterbore diameter or depth, click the Shape tab and type or select a new counterbore diameter or counterbore depth in the corresponding boxes.
10. To ensure that the entire top of the hole intersects the outside of the solid geometry, on the Shape tab, make sure that the Top Clearance check box is selected.
11. To select the bodies from which geometry is removed, click the Body Options tab and select an option:
◦ To cut geometry from all the bodies that the feature passes through, select All.
◦ To cut geometry from selected bodies:
1. Select Selected.
2. Click the body collector, and then select bodies from which to cut geometry.
12. Click 
OK.
OK.