To Create a Parallel Blend by Selecting the Sections
1. Click > > . The Blend tab opens.
2. Click
Solid to create a solid feature, or click
Surface to create a surface feature.
3. To select chains to use as the first section, click
Selected Sections, or select
Selected sections on the
Sections tab.
4. Click the Sections tab, and do the following:
a. Select chains to define the first section. Optionally, click Details to open the Chain dialog box to select chains.
b. To create another section, on the Sections tab, click Insert, click Details to open the Chain dialog box, select chains, and click OK.
| If the first section is defined using selected chains, the rest of the sections in the blend must also be selected. |
c. If required, select more sections by repeating the previous step.
5. To remove material along the blend to create a cut, click
Remove Material. Click
to remove material from the other side of the sketch.
6. Click the Options tab, and select Straight to connect the blend sections with straight lines and connect the edges of the sections with ruled surfaces, or Smooth to create smooth lines and connect the edges of the sections with spline surfaces.
7. Click the Tangency tab, and select a tangency condition for each start and end section.
8. For a
solid feature, click the
Body Options tab, and then select the body to which to add geometry, or from which to remove geometry:
◦ Add geometry
▪ To add geometry to an existing body, click the body collector, and then select the body to which geometry is added.
▪ To create the feature in a new body, select the Create new body check box. The name of the new body appears in the body collector.
◦ Remove geometry
▪ To cut geometry from all the bodies that the feature passes through, select All.
▪ To cut geometry from selected bodies:
1. Select Selected.
2. Click the body collector, and then select bodies from which to cut geometry.
9. Click
OK.