To Add and Assign a Material to a Part
The parameter PTC_MASTER_MATERIAL sets the value of the material that is assigned automatically to any new body created in the part. The default value of PTC_MASTER_MATERIAL is PTC_SYSTEM_MTRL_PROPS. This material has empty properties when set for the first time. You can edit the properties of the PTC_SYSTEM_MTRL_PROPS.
A part created in Creo Parametric 6.0 and earlier contains one body and one material assigned to the part. The value of PTC_MASTER_MATERIAL is the material assigned to that part. If no material is assigned to the part, then the default value of PTC_MASTER_MATERIAL is PTC_SYSTEM_MTRL_PROPS.
Add materials to the part from the Materials dialog box. The first material added to a part is automatically set as the master material. The master material of the part is indicated by 
.
.You can open the Materials dialog box in one of the following ways:
• On the Model Tree, right-click the part and click 
Edit Materials.
Edit Materials.• On the Model Tree, right-click Materials and click Edit Materials.
Materials and click Edit Materials.• Click > > 
Model Properties. Click change in the Material line.
Model Properties. Click change in the Material line.The Materials dialog box contains the following fields:
Field | Contents |
|---|---|
Look-in box showing Material Directory | Displays Material Directory that is located in the path specified by the pro_material_dir configuration option. If you have not set the pro_material_dir configuration option, then the look-in box displays the default material directory, that is, <Creo load point>\text\materials-library. |
Materials in Library list on the right side of Common Folders | Displays the contents of the directory in the look-in box. |
Materials in Model list | Displays the list of materials present in the model. If no material is added to the part, this list displays the default material PTC_SYSTEM_MTRL_PROPS. |
Material Preview section | Displays the preview of the selected material. |
To Add a Material to a Part and Set the Master Material
1. Open the Materials dialog box.
2. Browse the Materials in Library list and select the material to add to the part.
 | If required, use the look-in box to browse to the directory that contains the required material files. The names of the materials in the directory are displayed in Materials in Library list. Material files have a *.mtl and *.mat extension. The files with the *.mat extension are files from releases prior to Pro/ENGINEER Wildfire 3.0. |
3. Double-click the material to add to the part. The material is added to the Materials in Model list. Alternatively, right-click the material and click Add to Model.
| | If a model does not contain any material, then the default material PTC_SYSTEM_MTRL_PROPS is displayed and the first material that you add to the model is set as the master material. |
4. Perform the following steps to set the master material:
a. In the Materials in Model list, right-click the material and click Set as Master. Alternatively, right-click the material in the Materials in Library list and click Set as Master. The Question message box appears.
b. Click OK to confirm. In the Materials in Model list, the master material is denoted by a blue arrow that precedes the name of the material.
that precedes the name of the material.5. Click OK. The Materials dialog box closes.
| | In a part, you can set only one master material. You cannot set a master material for an assembly. |
To Set a Different Master Material
You can set a different master material in one of the following ways:
• On the Model Tree, expand the Materials node. Select a material from the list, right-click, and click Set as Master.
Materials node. Select a material from the list, right-click, and click Set as Master.• On the Model Tree, click the PTC_MASTER_MATERIAL column. Click the arrow and select a material from the list.
• In the Materials dialog box, select a material in the Materials in Model list, right-click, and click Set as Master.
• In the Parameters dialog box, select the Value cell for the parameter PTC_MASTER_MATERIAL, click the arrow, and select a material from the list.
To Assign a Crosshatch Pattern
1. Right-click a part or assembly, on the shortcut menu, click Edit Materials. The Materials dialog box opens. Click 
. The Material Definition dialog box opens.
Edit Materials. The Materials dialog box opens. Click . The Material Definition dialog box opens.2. Open a PAT file in the text editor, such as Notepad, and copy a pattern name. Paste the pattern name, in the Miscellaneous tab, under the Detailing section, in the Cross Hatching text box.
| | The pattern name of a material has a limit of 80 characters. You can define the characters in the Cross Hatching text box. |
3. Click Save to Model. Click OK. The selected material is displayed under Materials on the Model Tree.
4. On the graphics toolbar, click View Manager. Select the Section tab and click the New list. Select the cross section that you want to apply and press Enter. The created cross section is displayed under Sections on the Model Tree.
5. Assign the material from the Model Tree.
6. Activate the cross-section for which you want to assign the material.
7. Right-click the cross-section and click Edit Hatching. On the Edit Hatching dialog box, select the Use hatch from the part option to apply the pattern.