&d#

Displays a dimension in a drawing note, where # is the dimension ID.

&ad#

Displays an associative dimension in a drawing note, where # is the dimension ID.

&rd#

Displays a reference dimension in a drawing note, where # is the dimension ID.

&p#

Displays an instance number of a pattern in a drawing note, where # is the pattern ID.

&g#

Displays a gtol in a drawing note, where # is the gtol ID.

&<param_name>

Displays a user-defined parameter value in a drawing note.

&<param_name>:att_cmp

An object parameter that indicates the parameters of the component to which a note is attached.

&<param_name>:att_edge

An object parameter that indicates the parameters of the edge to which a note is attached.

&<param_name>:att_feat

An object parameter that indicates the parameters of the feature to which a note is attached.

&<param_name>:att_mdl

An object parameter that indicates the parameters of the model to which a note is attached.

&<param_name>:att_pipe_bend

An object parameter that indicates the parameters of the pipe bend to which a note is attached.

&<param_name>:att_spool

An object parameter that indicates the parameters of the spool to which a note is attached.

&<param_name>:EID_<edge_name>

An object parameter that references edges.

&<param_name>:FID_<feat_ID>

An object parameter that includes a feature parameter in a note by ID.

&<param_name>:FID_<FEAT_NAME>

An object parameter that includes a feature parameter in a note by name.

&<param_name>:SID_<surface_name>

An object parameter that references surfaces.

&angular_tol_0_0

Specifies the format of angular tolerance values in a note from one to six decimal places.

&sheet_number

Displays a drawing label indicating the current sheet number.

&sheet_name

Displays a drawing label indicating the current sheet name.

&det_scale

Displays a drawing label indicating the scale of a detailed view. You cannot use this parameter in a drawing note. Creo Elements/Pro creates this parameter with a view and places it in notes automatically. You can modify its value, but you cannot call it out in another note.

&dtm_name

Displays datum names in a drawing note, where name is the name of a datum plane. The datum name in the note is read-only, so you cannot modify it; unlike dimensions, a datum name does not disappear from the model view if included in a note. The system encloses its name in a rectangle, as if it were a set datum.

&dwg_name

Displays a drawing label indicating the name of the drawing.

&format

Displays a drawing label indicating the format size (for example, A1, A0, A, B, and so forth).

&linear_tol_0_0

Specifies the format of dimensional tolerance values in a note from one to six decimal places.

&model_name

Displays a drawing label indicating the name of the model used for the drawing.

&parameter:d

Adds drawing parameters to a drawing note, where parameter is the parameter name and :d refers to the drawing. .

&<param_name>:mdl

Adds a model parameter to a drawing note, table cell, or drawing Program where <param_name> is the parameter name.  Using the :mdl suffix prevents the drawing from switching the parameter reference from the model to the drawing (&parameter:d) if the model parameter cannot be located.

&pdmdb

Displays the database of origin of the model.

&pdmrev

Displays the model revision.

&pdmrev:d

Displays the revision number of the model (where :d refers to the drawing).

&pdmrl

Displays the release level of the model.

&scale

Displays a drawing label indicating the scale of the drawing.

&scale_of_view_detailed_bar

&sym(<symbolname )

Includes a drawing symbol in a note, where symbolname is the name of the symbol.

&todays_date

Displays a drawing label indicating the date on which the note was created in the form dd-mm-yy (for example, 2-Jan-92). You can edit it as any other nonparametric note, using Text Line or Full Note.

If you include this symbol in a format table, the system evaluates it when it copies the format into the drawing.

To specify the initial display of the date in a drawing, use the configuration file option "todays_date_note_format."

&total_sheets

Displays a drawing label indicating the total number of sheets in the drawing.

&type

Displays a drawing label indicating the drawing model type (for example, part, assembly, etc.).

&view_name

Displays a drawing label indicating the name of the view. You cannot use this parameter in a drawing note. Creo Elements/Pro creates it with a view and places it in notes automatically. You can modify its value, but you cannot call it out in another note.

&view_scale

Displays a drawing label indicating the name of a general scaled view. You cannot use this parameter in a drawing note. Creo Elements/Pro creates it with a view and places it in notes automatically. You can modify its value, but you cannot call it out in another note.

Pro/REPORT System Parameters

&asm.mbr.comp....

Retrieves information about the component from the model data and displays it in the report table.

&asm.mbr.cparam....

Retrieves a given component parameter.

&asm.mbr.cparams....

Lists information pertaining to all component parameters for the current model.

&asm.mbr.name

Displays the name of an assembly member. To show tie wraps and markers, the region attributes must be set to Cable Info.

&asm.mbr.param....

Displays information about parameters in an assembly member.

&asm.mbr.type

Displays the type (part or assembly) of an assembly member.

&asm.mbr.User Defined

Lists the specified user-defined parameter for the respective assembly components. Note that "&asm.mbr." can be used as a prefix before any user-defined parameter in an assembly member.

&dgm....

&fam....

Retrieves Family Table information about the model.

&harn....

Shows cable harness parameters for 3-D harness parts and flat harness assemblies.

&lay....

Retrieves layout information about the model.

&mbr....

Retrieves parameters about a single component.

&mdl....

Retrieves information about a single model.

&prs....

Retrieves process-specific report parameters used to create reports on the entire process sequence.

&rpt....

Displays information about each record in a repeat region.

&rpt.index

Displays the number assigned to each record in a repeat region.

&rpt.level

Shows the recursive depth of an item in a repeat region.

&rpt.qty

Displays the quantity of an item in a repeat region.

&weldasm....

Retrieves welding information about the model.

&asm.mbr.cblprm....

Lists values for a given cabling parameters.

&asm.mbr.cblprms....

Lists values for cabling and wire parameters.

&asm.mbr.connprm....

Lists parameters for connector pins in flat harness assemblies.

&asm.mbr.location...

Lists the location callouts in a specified view or all views of the drawing in session.

&asm.mbr.pipe....

Shows pipeline, pipe segment, and Pro/REPORT bend information parameters.

&asm.mbr.generic.name….

Lists the generic name information for a Family Table instance in a table.

&asm.mbr.topgeneric.name….

Lists the top generic name information for a Family Table instance in a table when working with a nested Family Table.