System Parameters for Drawings
The following table lists all system parameters available for use in drawings, classified according to functionality.
PARAMETER NAME
DEFINITION
&d#
Displays a dimension in a drawing note, where # is the dimension ID.
&ad#
Displays an associative dimension in a drawing note, where # is the dimension ID.
&rd#
Displays a reference dimension in a drawing note, where # is the dimension ID.
&p#
Displays an instance number of a pattern in a drawing note, where # is the pattern ID.
&g#
Displays a gtol in a drawing note, where # is the gtol ID.
&<param_name>
Displays a user-defined parameter value in a drawing note.
&<param_name>:att_cmp
An object parameter that indicates the parameters of the component to which a note is attached.
&<param_name>:att_edge
An object parameter that indicates the parameters of the edge to which a note is attached.
&<param_name>:att_feat
An object parameter that indicates the parameters of the feature to which a note is attached.
&<param_name>:att_mdl
An object parameter that indicates the parameters of the model to which a note is attached.
&<param_name>:att_pipe_bend
An object parameter that indicates the parameters of the pipe bend to which a note is attached.
&<param_name>:att_spool
An object parameter that indicates the parameters of the spool to which a note is attached.
&<param_name>:EID_<edge_name>
An object parameter that references edges.
&<param_name>:FID_<feat_ID>
An object parameter that includes a feature parameter in a note by ID.
&<param_name>:FID_<FEAT_NAME>
An object parameter that includes a feature parameter in a note by name.
&<param_name>:SID_<surface_name>
An object parameter that references surfaces.
&angular_tol_0_0
Specifies the format of angular tolerance values in a note from one to six decimal places.
&sheet_number
Displays a drawing label indicating the current sheet number.
&sheet_name
Displays a drawing label indicating the current sheet name.
&det_scale
Displays a drawing label indicating the scale of a detailed view. You cannot use this parameter in a drawing note. Creo Elements/Pro creates this parameter with a view and places it in notes automatically. You can modify its value, but you cannot call it out in another note.
&dtm_name
Displays datum names in a drawing note, where name is the name of a datum plane. The datum name in the note is read-only, so you cannot modify it; unlike dimensions, a datum name does not disappear from the model view if included in a note. The system encloses its name in a rectangle, as if it were a set datum.
&dwg_name
Displays a drawing label indicating the name of the drawing.
&format
Displays a drawing label indicating the format size (for example, A1, A0, A, B, and so forth).
&linear_tol_0_0
Specifies the format of dimensional tolerance values in a note from one to six decimal places.
&model_name
Displays a drawing label indicating the name of the model used for the drawing.
&parameter:d
Adds drawing parameters to a drawing note, where parameter is the parameter name and :d refers to the drawing. .
&<param_name>:mdl
Adds a model parameter to a drawing note, table cell, or drawing Program where <param_name> is the parameter name.  Using the :mdl suffix prevents the drawing from switching the parameter reference from the model to the drawing (&parameter:d) if the model parameter cannot be located.
&pdmdb
Displays the database of origin of the model.
&pdmrev
Displays the model revision.
&pdmrev:d
Displays the revision number of the model (where :d refers to the drawing).
&pdmrl
Displays the release level of the model.
&scale
Displays a drawing label indicating the scale of the drawing.
&scale_of_view_detailed_bar
&sym(<symbolname )
Includes a drawing symbol in a note, where symbolname is the name of the symbol.
&todays_date
Displays a drawing label indicating the date on which the note was created in the form dd-mm-yy (for example, 2-Jan-92). You can edit it as any other nonparametric note, using Text Line or Full Note.
If you include this symbol in a format table, the system evaluates it when it copies the format into the drawing.
To specify the initial display of the date in a drawing, use the configuration file option "todays_date_note_format."
&total_sheets
Displays a drawing label indicating the total number of sheets in the drawing.
&type
Displays a drawing label indicating the drawing model type (for example, part, assembly, etc.).
&view_name
Displays a drawing label indicating the name of the view. You cannot use this parameter in a drawing note. Creo Elements/Pro creates it with a view and places it in notes automatically. You can modify its value, but you cannot call it out in another note.
&view_scale
Displays a drawing label indicating the name of a general scaled view. You cannot use this parameter in a drawing note. Creo Elements/Pro creates it with a view and places it in notes automatically. You can modify its value, but you cannot call it out in another note.
Pro/REPORT System Parameters
&asm.mbr.comp....
Retrieves information about the component from the model data and displays it in the report table.
&asm.mbr.cparam....
Retrieves a given component parameter.
&asm.mbr.cparams....
Lists information pertaining to all component parameters for the current model.
&asm.mbr.name
Displays the name of an assembly member. To show tie wraps and markers, the region attributes must be set to Cable Info.
&asm.mbr.param....
Displays information about parameters in an assembly member.
&asm.mbr.type
Displays the type (part or assembly) of an assembly member.
&asm.mbr.User Defined
Lists the specified user-defined parameter for the respective assembly components. Note that "&asm.mbr." can be used as a prefix before any user-defined parameter in an assembly member.
&dgm....
&fam....
Retrieves Family Table information about the model.
&harn....
Shows cable harness parameters for 3-D harness parts and flat harness assemblies.
&lay....
Retrieves layout information about the model.
&mbr....
Retrieves parameters about a single component.
&mdl....
Retrieves information about a single model.
&prs....
Retrieves process-specific report parameters used to create reports on the entire process sequence.
&rpt....
Displays information about each record in a repeat region.
&rpt.index
Displays the number assigned to each record in a repeat region.
&rpt.level
Shows the recursive depth of an item in a repeat region.
&rpt.qty
Displays the quantity of an item in a repeat region.
&weldasm....
Retrieves welding information about the model.
&asm.mbr.cblprm....
Lists values for a given cabling parameters.
&asm.mbr.cblprms....
Lists values for cabling and wire parameters.
&asm.mbr.connprm....
Lists parameters for connector pins in flat harness assemblies.
&asm.mbr.location...
Lists the location callouts in a specified view or all views of the drawing in session.
&asm.mbr.pipe....
Shows pipeline, pipe segment, and Pro/REPORT bend information parameters.
&asm.mbr.generic.name….
Lists the generic name information for a Family Table instance in a table.
&asm.mbr.topgeneric.name….
Lists the top generic name information for a Family Table instance in a table when working with a nested Family Table.