To Merge Two Parts in an Assembly
1. Retrieve an assembly, select a part, right-click, and choose
Activate.
| The Merge feature will be created in the selected part. |
2. Select a second part in the assembly as the reference model from which geometry will be copied and click Get Data > Merge/Inheritance. The Merge/Inheritance tab opens with the reference model selected by default. You can replace the reference model by selecting a different part from the Model Tree or graphics window.
3. Define the Merge feature properties as follows:
◦ —Add (default) or remove material geometry.
◦ —Set reference type to assembly context (default).
◦ —Set reference type to external (create an external Merge feature).
◦ Click References to define the following options:
▪ Edit—Control propagation of annotation features.
▪ Copy Datums—Toggle datum copying from the original feature to the Merge feature.
| You can copy datums only if the Dependent option is active. If the feature is independent, no datums are copied. Datums may be refited with existing geometry only. |
◦ Click Options to define the following:
▪ Automatic Update—Keeps the relationship between the current feature and the original geometry.
▪ Manual Update—Temporarily suspends the relationship between the current feature and the original geometry. If the original part changes, the current feature does not change.
▪ No Dependency—Creates an independent merge feature.
| If a Merge feature is independent, you cannot externalize the feature. |
◦ Click Properties to change Merge feature name.
4. Click
to complete the Merge feature.