Inheritance Features Capabilities

Assembly Design > Top Down Design > Data Sharing > Merge and Inheritance Features > Inheritance Features > Inheritance Features Capabilities

• Changes in the reference part are associatively propagated to the dependent Inheritance feature when both reference and target parts are in the same session. You can control whether Inheritance features are dependent on the reference part.

• Creation or modification of varied items is possible without the reference part in the current session.

• Addition or removal of material geometry.

• Varied items values can be driven by associative parameters owned by the Inheritance feature. The associative parameters can be modified using Creo Parametric tools, either manually, via Relations, using a Family Table, and so on.

• The ability to change annotation properties.

• The conversion of an inheritance feature to an external Inheritance feature.

• Nest Inheritance features.

• The monitoring of parent and child relationships between subfeatures of Inheritance and other features of the part that reference them.

The following operations can be performed on varied items for Inheritance features.

Varied Item	Operations
Feature	Suppress, resume, erase, restore
Parameter	Value
Reference	New, affected features
3D Note	Copy, Don’t Copy, Visibility
3D Symbol	Copy, Don’t Copy
Surface Finish	Copy, Don’t Copy, Value
Geometry Tolerance	Copy, Don’t Copy, Value
Dimension	Value, tolerances, boundary, varied properties (annotation backup)

When you already have an Inheritance or external Inheritance feature in your Model Tree, right-click the Inheritance feature in the Model Tree, and select Varied Items from the shortcut menu. The Varied Items dialog box opens.