To Create a Mirrored Copy of a Part inside an Assembly
1. Retrieve an assembly.
2. Click
or select a component in the Model Tree, right-click, and select
Mirror Component. The
Mirror Component dialog box opens.
3. Select the component to mirror.
4. Select a mirror plane. This can be a datum plane or a surface.
| It is good practice to mirror about a plane belonging to the part to be mirrored. |
5. Under New component, select one of the following options:
◦ Create a new model (default)—Creates a new mirrored part.
◦ Reuse selected model—Reuses the part to create the mirror part.
6. To change the default name, type a name for the new part.
7. Under Mirror, select one of the following options:
◦ Geometry only (default)—Creates a mirrored copy of the original part geometry.
◦ Geometry with features—Creates a mirrored copy of the geometry and features of the original part.
8. Under Dependency control, set one or both of the following parameters:
◦ Geometry dependent—Updates the mirrored part geometry when the original part geometry is modified.
◦ Placement dependent—Updates the mirrored part placement when the original part placement is modified.
| When you use Geometry with features, the geometry of the new part is not dependent on the geometry of the source part. |
9. Click Perform symmetry analysis and follow the steps below, or click OK or middle-click to exit the tool. A mirrored copy of the component is placed in the assembly.
Performing a Symmetry Analysis
You can reuse symmetric and anti-symmetric parts to eliminate the need of creating new mirror parts.
1. Under Symmetry Analysis, select the following options:
◦ Perform symmetry analysis—Performs a symmetry analysis.
The system checks the selected part for symmetry and checks for anti-symmetric parts in the assembly.
2. Click OK. The component is placed as a mirror component in the assembly.