• The merge or inheritance feature created is an external feature. Click Merge/Inheritance to toggle between Inheritance mode (default) and Merge mode.

• The Merge feature is available for solid bodies in Sheetmetal Design. Sheetmetal does not support merge, it creates a solid body or solid bodies when you select the Add Bodies option.

◦ Add Bodies—Bodies of the source part are copied and added as bodies to the target part, increasing the number of bodies in the target part. Solid bodies remain solid bodies and sheet metal bodies remain sheet metal bodies.

◦ Merge—The source geometry is copied and merged with the target geometry. When you select multiple bodies in the source, they are merged into 1 body and it is copied to the target. You cannot, however, select multiple not empty bodies in the source model when the target body is a sheet metal body. When the target sheet metal body contains a first wall, then the reference sheet metal body must have the same thickness defined for any sheet metal geometry. You can merge solid geometry to solid geometry, but not to sheet metal geometry.

◦ Cut—Geometry of the source is removed from geometry of the target. You can perform the following operations:

▪ Normal to Surface selected (default)—Creates sheet metal cuts that remove solid material from the sheet metal wall, normal to the driven or to the offset surface.

▪ Normal to Surface not selected—Creates solid cuts that remove solid material from the sheet metal wall, normal to the sketch plane, and from solid bodies.

◦ Intersect—Geometry of the source is intersected with the geometry of the target keeping the shared geometry. You can perform the following operations:

▪ Normal to Surface selected (default)—Intersects sheet metal walls, to make the shared walls normal to the driven or to the offset faces.

▪ Normal to Surface not selected—Intersects solid bodies and sheet metal walls normal to the sketch plane.