To Create a 4 Axis Area Turning NC Sequence
Ensure that the active operation references a 2-turret Lathe or a Mill/Turn workcell with multiple heads.
1. Click > 
Four Axis Area Turning. The Dual Head Area Turning tab opens.
Four Axis Area Turning. The Dual Head Area Turning tab opens.2. Select 
Head 1 (default) or 
Head 3 under Workcell in the turning sequence.
Head 1 (default) or Head 3 under Workcell in the turning sequence.Any Head that you select under Workcell is considered as the lead head.
3. Select 
Head 2 or 
Head 4 under Follow Head in the turning sequence.
Head 2 or Head 4 under Follow Head in the turning sequence.4. Click 
Tool Manager corresponding to Head 1, Head 3, Head 2, or Head 4 to open the Tools Setup dialog box. To add a new cutting tool, select 
Edit Tools from the Tool list to open the Tools Setup dialog box.
Tool Manager corresponding to Head 1, Head 3, Head 2, or Head 4 to open the Tools Setup dialog box. To add a new cutting tool, select Edit Tools from the Tool list to open the Tools Setup dialog box.Alternatively, right-click the graphics window and select Tools.
 | • Tool geometry must be similar on both the heads. However, tool name and ID can differ. • Any tool that you create for the Lead Head is not automatically available for Follow Head. You can manually create a similar tool for Follow Head. Alternatively, you can change the heads on Follow Head to copy the tool on Follow Head. |
5. On the Parameters tab, specify the required basic manufacturing parameters. You can also click 
to define advanced machining parameters or click 
to copy machining parameters from another step. By default, the required parameters are defined by relations that you can modify from the Relations dialog box.
to define advanced machining parameters or click to copy machining parameters from another step. By default, the required parameters are defined by relations that you can modify from the Relations dialog box.Alternatively, right-click in the graphics window and select Parameters.
6. On the Clearance tab, specify the Start point and End point of Lead Head and Follow Head for the step tool path.
7. On the Tool Motions tab, select Four Axis Area Turning Cut from the list to define the 4 axis area turning cut. The Area Turning Cut dialog box opens.
| | The Tool Motions tab is available only after you have defined the mandatory parameters such as tool and step parameters. |
a. To define a stock boundary, click the Stock collector to select a workpiece or stock boundary feature to represent the stock boundary.
Alternatively, right-click the graphics window and select Turn Stock Boundary Collector.
To create a new stock boundary, click 
Geometry > 
Stock Boundary on the Dual Head Area Turning tab. The Stock Boundary tab opens. To create a stock boundary, see the Related Links for more information.
Geometry > Stock Boundary on the Dual Head Area Turning tab. The Stock Boundary tab opens. To create a stock boundary, see the Related Links for more information.b. Click the Turn Profile collector to select an existing turn profile.
Alternatively, right-click the graphics window and select Turn Profile Collector.
To create a new turn profile, click Geometry > Turn Profile on the Dual Head Area Turning tab. The Turn Profile tab opens. To create a turn profile, see the Related Links for more information.
Geometry > Turn Profile on the Dual Head Area Turning tab. The Turn Profile tab opens. To create a turn profile, see the Related Links for more information.c. Select the Start Extension and End Extension options to extend the ends of the turn profile to intersect the stock.
Alternatively, right-click the start or end point of turn profile and select No Extension, Add Extension, or Next Extension.
d. Adjust the cut motion ends under Options.
Alternatively, right-click the graphics window and select Start Collector and End Collector to select a coordinate system or plane.
e. Specify the corner conditions as Sharp, Fillet, or Chamfer under Corners.
f. Click OK.
The follow cuts for Lead Head and Follow Head are visible on the Tool Motions tab.
| | • After you define the 4 axis Area turning cut, you cannot use Four Axis Area Turning Cut again to create a new 4 axis Area turning cut. You can create and edit only follow curve tool motion after you define the 4 axis Area turning cut. • The Delete option is available for Above Spindle Cut corresponding to the Lead Head, Below Spindle Cut corresponding to the Follow Head, and Follow Cut. However, if you delete any spindle cut or the corresponding follow cut, all spindle cuts and follow cuts are deleted. • You can edit definition of 4 axis area turning cut only for Above Spindle Cut corresponding to the Lead Head. |
8. Create additional approach motions, exit motions, CL commands, and Goto points by selecting options from the list on the Tool Motions tab.
9. On the Process and Properties tabs, specify any additional values.
10. To animate the tool path display, click 
on the Dual Head Area Turning tab. The Play Synchronized Path dialog box opens. For more information on using the Play Synchronized Path dialog box, see About the Play Synchronized Path Dialog Box.
on the Dual Head Area Turning tab. The Play Synchronized Path dialog box opens. For more information on using the Play Synchronized Path dialog box, see About the Play Synchronized Path Dialog Box.11. Click 
.
.| | You can use the object-action behavior by selecting a predefined turn profile from the Model Tree and clicking > Four Axis Area Turning. After specifying the mandatory step parameters and tool parameters, the tool motion is automatically defined based on the selected turn profile. |