To Create Attached Flat Walls
When you select multiple edges, to create multiple flat walls, they are created at the same time with the same properties. Only one wall in the preview is active for editing. By default, it is the wall attached to the first edge you selected. You can change the wall to edit when you select a different wall, but all walls are updated at the same time.
1. Click > 
Flat. The Flat tab opens.
Flat. The Flat tab opens.2. Click Placement and select one or more attachment edges. The selected edges are displayed in the collector.
A rectangular wall is created by default. To choose a different wall shape, select one from the Shape list.
3. Click Shape and set dimensions for the walls using one of the following actions:
◦ Modifying the default rectangular wall dimensions:
▪ Drag the handles to set the dimensions.
▪ Click a wall dimension and edit the value.
◦ Creating a sketched wall:
▪ To select a profile file for the wall, click Open.
▪ To create a profile or edit the wall dimensions using the Sketcher window, click Sketch When more than one edge was selected, you are prompted to convert the feature section to a 2D sketch.
▪ To save the profile you created, click Save As.
▪ To convert a feature section to a 2D sketch, click Convert.
◦ Set the option for attaching the shape.
4. Set a bend angle for the attachment walls by using one of the following actions:
◦ Click the Angle list 
and select a bend angle value for the attachment walls.
and select a bend angle value for the attachment walls.Alternatively, you can type a value in the Angle box.
◦ Drag the handles to adjust the angle.
◦ Double-click an angle value and type a new one.
5. Click 
to flip the thickness from one side of the sketch plane to the other.
to flip the thickness from one side of the sketch plane to the other.6. Click 
to add a bend on the attachment edges. Select a thickness value from the list, and then select one of the options to apply a method for dimensioning the bend:
to add a bend on the attachment edges. Select a thickness value from the list, and then select one of the options to apply a method for dimensioning the bend:◦ Click 
to dimension the radius from the outside surface of the wall.
to dimension the radius from the outside surface of the wall.◦ Click 
to dimension the radius from the inside surface of the wall.
to dimension the radius from the inside surface of the wall.◦ Click 
to dimension the radius according to the location controlled by the SMT_DFLT_RADIUS_SIDE parameter.
to dimension the radius according to the location controlled by the SMT_DFLT_RADIUS_SIDE parameter.7. Click Bend Position and select one of the five types.
If you select 
Offset from Bend Start or 
Offset from Bend Apex, then type a value for the offset.
Offset from Bend Start or Offset from Bend Apex, then type a value for the offset.8. When you create two non-tangent walls segments, click Corner Treatment to define the way the segments intersect.
9. When you create two tangent wall segments, click Miter Cut to define the way the segments intersect.
10. Click Relief and select Bend Relief or Corner Relief.
If you select Bend Relief:
◦ To define the same relief for both sides, make sure the Define each side separately check box is cleared and select a relief type to apply from the Type list.
◦ To define a different relief for each side, click the Define each side separately check box, select Side 1, and then select a relief type to apply from the Type list. Repeat for Side 2.
When defining a bend relief for both sides or separately:
▪ For a Stretch relief, set the angle value and width.
▪ For Rectangular and Obround reliefs, set values for the depth, length, and width.
If you select Corner Relief and Define corner relief:
◦ Clear the Create relief geometry check box if you want to define the corner but create the geometry using Unbend or Flat Pattern features.
◦ Select a relief Type, Origin, and Orientation option
11. To set feature-specific bend allowance and calculate the developed length using a different method from that of the part, perform the following operations:
a. Click Bend Allowance. The Bend Allowance tab opens.
b. Select Use feature settings.
c. Perform one of the following operations:
▪ Click By K factor or By Y factor and type a new factor value or select one from the list.
▪ To use a bend table to calculate developed length for arcs, click By bend table. Use the default table or select a new one from the list.
12. Click 
.
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