About the Edge Bend User Interface
The Edge Bend user interface consists of commands, tabs, and shortcut menus. On the Sheetmetal tab, click the arrow next to Bend and then click 
Edge Bend to access the Edge Bend tool.
Edge Bend to access the Edge Bend tool.Use the following configuration options to control the default values and behavior of selected tool settings:
• smt_drive_tools_by_parameters—Uses parameter values as the default values of selected tool settings and to automatically update features when parameter values change.
• smt_drive_bend_by_parameters—Uses parameter values to control the default value of bend angle and bend dimension location settings and to automatically update features when parameter values change.
 | If you want to enable smt_drive_bend_by_parameters, you must also set smt_drive_tools_by_parameters to yes. |
In the following descriptions, [<Parameter Value>] indicates that tool settings are controlled by parameters.
Commands
• Bend Radius list—Rounds sharp edges according to a specified value. Default values are as follows:
◦ Thickness—Uses a radius equal to the thickness of the sheet metal wall.
◦ 2.0 * Thickness—Uses a radius equal to twice the thickness of the sheet metal wall.
◦ [<Parameter Value>]—Uses a radius whose value is set by the SMT_DFLT_BEND_RADIUS parameter.
• Dimension Location buttons:
◦ 
—Dimensions the radius according to the outside surface of the wall.
—Dimensions the radius according to the outside surface of the wall.◦ 
—Dimensions the radius according to the inside surface of the wall.
—Dimensions the radius according to the inside surface of the wall.◦ 
—Dimensions the radius according to the location set by the SMT_DFLT_RADIUS_SIDE parameter.
—Dimensions the radius according to the location set by the SMT_DFLT_RADIUS_SIDE parameter.Tabs
• Placement
Use this tab to select edge bend references.
◦ Edge Bend Set list—Displays any defined sets of edge bends. Click New Set to define a new set of edge bends.
◦ Edges—Displays selected edges or chain of edge references in the collector.
◦ Details—Opens the Chain dialog box.
◦ Bend radius—Adds a bend to the selected set by a specified value. Default values for the radius are as follows:
▪ Thickness—Uses a radius equal to the thickness of the sheet metal wall.
▪ 2.0 * Thickness—Uses a radius equal to twice the thickness of the sheet metal wall.
▪ [<Parameter Value>]—Uses a radius whose value is set by the SMT_DFLT_BEND_RADIUS parameter.
◦ Bend Dimension Location options:
▪ Inside—Dimensions the bend radius from the inside surface of a bend.
▪ Outside—Dimensions the bend radius from the outside surface of a bend.
▪ [<Parameter Value>]—Dimensions the bend radius according to the dimension location set by the SMT_DFLT_RADIUS_SIDE parameter.
• Relief
Use this tab to define relief.
◦ Type—Lists the types of relief:
▪ No Relief—Adds no relief.
▪ Rip
—Adds a rip relief.
▪ Stretch—Adds a stretch relief.
▪ Rectangular—Adds a rectangular-shaped relief.
▪ Obround—Adds an obround-shaped relief.
▪ [<Parameter Value>]—Adds a relief set by the SMT_DFLT_BEND_REL_TYPE parameter
• Bend Allowance
Use this tab to set a feature-specific bend allowance to calculate the developed length of the bend.
◦ Use part settings—Uses the developed length calculation set for the part.
◦ Use feature settings—Uses the developed length calculation defined below.
▪ By K factor—Calculates the developed length according to the K factor. To change the value for K factor, type a new factor value or select a value from the list.
▪ By Y factor—Calculates the developed length according to the Y factor. To change the value for Y factor, type a new factor value or select a value from the list.
▪ By bend table—Calculates the developed length using a bend table. To choose a different bend table, select one from the list.
• Properties
Use this tab to display detailed feature information:
◦ Name—Shows a name for the edge bend feature.
◦ 
—Shows feature information in a browser.
—Shows feature information in a browser.Shortcut Menus
Right-click the graphics window to access the shortcut commands:
• Clear—Removes references from the active collector.
• Edges—Activates the Edges reference collector.
• Add Edge Bend—Adds a new set of edge bends.
Right-click the Dimension Location handle to access the shortcut commands:
• Inside Radius—Dimensions the radius from the inside surface of the bend.
• Outside Radius—Dimensions the radius from the outside surface of the bend.
• [<Parameter Value>]—Dimensions the bend radius according to the dimension location set by the SMT_DFLT_RADIUS_SIDE parameter.