If you have a part that is available in multiple sizes, you can add it to the library as a parametric part. We recommend that you add new parts to the Company group so they won't be overwritten when you upgrade or reinstall Creo Elements/Direct Part Library.
You must have licenses for Creo Elements/Direct Part Library and Creo Elements/Direct Advanced Design to add parametric parts to the library.
You should not change the default row with the name GENERIC.
To add a parametric part to your library,
1. Create a part.
2. Create relations for the dimensions you want to change on the library part. All parametric relation types are supported.
3. Update the relation set for the part.
Now you can add the parametric part to the library:
1. Click Part Library and then, in the Catalog group, click the arrow next to Save.
2. Click Dynamic Part.
3. Select the part in the viewport or Structure Browser.
You can also select an assembly which has parametric relations.
4. Select a Group in the Standard Parts dialog box. The Company group is recommended.
5. Click OK.
6. The Create parametric part dialog opens. Here you can change the settings for your new part:
◦ Part name: This is displayed in the list of parts you can load. You can only use letters, numbers, and underscores (_).
◦ Menutext: This is displayed as the title of the part.
◦ Caption: This is displayed as the title of the load part dialog.
◦ Table icon: This is the icon displayed for the part.
◦ Parent group: The default is Company, but you can change the group.
◦ Parent icon: This is the icon displayed for the parent group, or category, in the part load dialogs.
◦ Standard: Select DIN, DIN-EN, or Other.
◦ CAD operation: A LISP function that generates new parts. You can use your own LISP code, or you can use the following predefined functions:
▪ custom::ts_catalog_load_dyn_para Name: Creates a new part based on the dimensions you set up in the table. If you use this function, you can set up many different parameters for different size parts.
▪ custom::ts_catalog_load_dyn_para_pool Name: Loads the part with one set of parameters. If you use this function, you can only set up one set of parameters and this part will always be the same.
◦ CAD-File: You can select a saved PKG file to use for the part.
◦ Table > Import: You can import an existing parameter file (*.par) to create your own table of parts.
◦ Table > Modify: You can add new definitions to this part so you can load it with several different dimensions. Add, remove, or change dimensions in this dialog. Double-click a field to change its value.
You must enter values in mm even if your system settings are in inches.
◦ Table > Show column: Toggle the columns that are displayed in the table editor.
◦ Variables: Create variables to use with your own custom LISP function.
7. Click Create to add the part and close the dialog.
You can also add a part by clicking Create part in the Administration section; however, the Dynamic Part command which is documented here is easier to use if you don't write your own LISP functions.
Save.
Dynamic Part.
.