Dialog Field (Keyword) | Type | Label | Description |
---|---|---|---|
Face (SEL_FACE) | Specifies the face for the drilling operation. Clicking a face automatically derives values for CenterPt and Axis Dir (providing you have not deactivated automatic parameter acquisition). | ||
Center Point (CEN_PNT) | 3D Position | Specifies the center point for the drilling operation. If the starting face is deleted later by other machining operations, the center point may be left hanging in space. If you click Face and click a point on a face, the center point is derived from this point (providing you have not deactivated automatic parameter acquisition). | |
Axis (AXIS) | 3D Axis (Direction + Position + Up-Direction) | Specifies the axis for the machined hole. If the starting face is deleted later by other machining operations, the center point may be left hanging in space. If you click Face and click a point on a face, the axis is derived normal to this point (providing you have not deactivated automatic parameter acquisition). | |
TAP Units (TAP_UNITS) | Keyword | :METRIC :INCH :BSW :BSF :BSP :UNC :UNF :NPT :PIPE_RP :PIPE_G :TRAPEZOID :FLAT_TRAPEZOID :SAW :ROUND :ROUND_MINING :EDISON :PIPE_JIS_B_0203 :PIPE_Pg :metric_fine The default is metric threads, if you have a metric length unit set within Creo Elements/Direct Modeling and :inch if you have set an imperial length unit. | |
Thread Diameter (THREAD_DIA) | Length | D1 | The nominal diameter of the thread. |
Thread Pitch (THREAD_SIZE) | Length | The pitch of the thread. | |
ThreadTpi (THREAD_TPI) | Number | Alternative method to specify the pitch of the thread by entering the Thread Per Inch value for all imperial style threads and pipe threads. | |
Starts (THREAD_STARTS) | Number | The number of thread starts. This value has no effect upon the geometrical representation of the threaded hole, but the data is needed for complete specification of the thread in order to create correct manufacturing documents. The default is 1. | |
Direction (THREAD_HAND) | Keyword | The direction of the thread. This value has no effect upon the geometrical representation of the threaded hole, but the data is needed for complete specification of the thread in order to create correct manufacturing documents. The following keywords are possible : :right (the default) :left | |
Nom.PipeDia. (NOMINAL_PIPE_DIA) | Length | The nominal diameter of a pipe thread, which is not the "outer" diameter of the thread. This value has no effect upon the geometrical representation of the threaded hole, but the data is needed for complete specification of the pipe thread in order to create correct manufacturing documents. | |
Drill Diameter (DRILL_DIA) | Length | The diameter of the hole to be drilled. | |
Drill Depth (DEPTH) | Length | T1 | Specifies the drilling depth. The depth is defined as the length of the drilled cylinder and does not include the tip of the drill tool. If you have added a tolerance to this parameter through the Creo Elements/Direct Annotation 3D module or by direct specification within the dialog, it is written into the output file to be transferred to the receiving CAM system (in either ISO or values). |
Chamfer Depth (CHAMFER_DEPTH) | Length | T2 | The depth of the chamfer measured in direction of the axis. |
Chamfer Angle (CHAMFER_ANGLE) | Angle | The tool tip angle of the sink tool. | |
Back Chamfer Depth (BACK_CHAMFER_DEPTH) | Length | T3 | The depth of the backside chamfer measured in direction of the axis. |
Back Chamfer Angle (BACK_CHAMFER_ANGLE) | Angle | The tool tip angle of the sink tool. | |
Name (NAME) | String | Specifies the name of the new feature. In case of modify this name is fixed, to modify the name of a feature please use rename. | |
Flag DP (FLAG_DP) | The docuplane which should own the flag text. If you switch on the variable for the first time within a dialog, the computed defaults will be activated. If you decide not to use the docuplane for the flag text but want to get a free flag text, simply switch off the variable. You can reactivate your last value (within the same dialog box) later by switching it on again | ||
DiaSfty (DRILL_DIA_SAFETY_ZONE_THICKNESS) | Length | The thickness of the diameter related safety zone (i.e. the wall thickness of the "pipe" around the hole) If you decide not to use the safety zone, simply switch off the variable. You can reactivate your last value (within the same dialog) later by switching it on again. |
Dialog Field (Keyword) | Type | Label | Description |
---|---|---|---|
(THREAD_TPI_NUM) | Non-negative Number | Method to specify the numerator part of a rational thread per inch value for the thread pitch. This parameter can be used only with threads of type :NPT and :UNC. If a positive value occurs within a customization table for another thread, the value will be forced silently to zero. | |
(THREAD_TPI_DEN) | Positive Number | Method to specify the denominator part of a rational thread per inch value for the thread pitch. This parameter can be used only with threads of type :NPT and :UNC. If a value greater than one occurs within a customization table for another thread, the value will be forced silently to one. |
Dialog Field (Keyword) | Type | Label | Description |
---|---|---|---|
(CHAM_DIA) | Non-negative length | An alternative method to specify the depth of the (front-)chamfer. The chamfer radius is the half of the diameter which can be measured within the SEL_FACE, if this face is a plane perpendicular to the axis. | |
(STD_TAP_CLEARANCE) | Positive Number | The difference between the drill depth and the tap depth. This value has no effect upon the ThreadedThroughHole. |
Dialog Field (Keyword) | Description |
---|---|
Show/Hide Image (IMAGE_SHOWN) | Shows/hides the graphical representation of the machined hole. |
Show/Hide Tolerance & Quality (TOLERANCE_AND_QUALITY) | Shows/hides additional safety zone related input fields. |
Next (NEXT) | Completes the current operation and prompts you for the next location (create, copy) or feature (modify) without closing the menu. |