To Create an Offset Wall
1. Click
Model >
Offset. The
Offset tab opens.
2. For a first wall, type a value for the wall thickness or accept the default value.
3. Select a quilt or surface as a reference for the offset.
|  Alternatively, you can first select the geometry and then click Offset. |
4. Make sure that
is selected.
5. Set the offset distance.
6. To flip the
material thickness direction, click
.
7. Click Options. The Options tab opens. Perform any of the following operations:
◦ Click the Special Handling collector and select one or more surfaces to exclude.
For more information about excluding surfaces, search the Help Center.
◦ Set sheetmetal-specific options:
▪ Click Add bends on sharp edges to round sharp edges when the sketch includes nontangent geometry. Set the value of the radius and the location for dimensioning the radius.
▪ Click Set driving surface opposite offset surface to flip the driving surface. Use this option when the wall is not a first wall.
▪ Click Merge to model to merge the wall to an existing wall in the design.
To keep the new wall edges from merging with an existing wall, click Keep merged edges.
8. To set feature-specific bend allowance and calculate the developed length using a different method from that of the part, perform the following operations:
a. Click Bend Allowance. The Bend Allowance tab opens.
b. Click Use feature settings.
c. Perform one of the following operations:
▪ Click By K factor or By Y factor and type a new factor value or select one from the list.
▪ To use a bend table to calculate developed length for arcs, click By bend table. Use the default table, select a new one from the list, or click Browse to browse to a different table.
| Only bend tables copied to the part are available. |
9. Click
.