To Create a Rotated Blend Wall
1. Click
Model >
Shapes >
Rotational Blend. The
Rotational Blend tab opens.
2. Make sure that
is selected to create a wall.
3. For a first wall, type a value for the wall thickness or accept the default value.
4. Choose a wall creation method:
◦ To sketch an internal section:
1. Click
, or click
Sketched sections on the
Sections tab.
2. Click Define and select a planar reference, a point, a vertex, or the end of a curve to define the sketch plane.
3. Sketch the first section and sketch a geometry centerline as the axis of revolution.
4. If the sketched section does not contain a geometry centerline, click the axis of revolution collector, and select a linear reference.
5. To sketch another section, click Insert on the Sections tab, define the sketch plane, and create a section. The rotated blend previews.
◦ To select sections:
1. Click
, or click
Selected sections on the
Sections tab.
2. Click the Sections tab and select chains to define the first section.
3. To add another section, click Insert an the Sections tab and select chains to define the section. The blended geometry previews.
|  For more information on using the Blend tools, search the Help Center. |
5. To set sheetmetal-specific options, click Options. The Options tab opens. Perform any of the following operations:
◦ Click Straight to connect the section edges with straight lines, or click Smooth to connect the section edges with spline surfaces.
◦ Click Add bends on sharp edges to round sharp edges when the sketch includes nontangent geometry. Set the value of the radius and the location for dimensioning the radius.
◦ Click Set driving surface opposite blended surface to flip the driving surface. This option is not available for a first wall.
◦ Click Merge to model to merge the wall with an existing wall in the design.
To keep the new wall edges from merging with the existing wall, click the Keep merged edges check box.
6. To set feature-specific bend allowance and calculate the developed length using a different method from that of the part, perform the following operations:
a. Click Bend Allowance. The Bend Allowance tab opens.
b. Click Use feature settings.
c. Perform one of the following operations:
▪ Click By K factor or By Y factor and type a new factor value or select one from the list.
▪ To use a bend table to calculate developed length for arcs, click By bend table. Use the default table, select a new one from the list, or click Browse to browse to a different table.
| Only bend tables copied to the part are available. |
7. Click
.