Sheetmetal > Designing in Sheetmetal Design > Creating and Modifying Walls > Creating Walls > Revolved Walls > To Create a Revolved Wall
  
To Create a Revolved Wall
Use the Revolve tool to create a revolved wall or when a revolved wall is not the first wall to create a revolved solid cut.
1. Click Model > Shapes > Revolve. The Revolve tab opens.
2. Select a sketch or click Placement > Define and create an internal sketch to revolve.
 
* In Sketcher, you can change the direction of material thickness and specify thickness for a section containing a single chain with tangent entities. Click Setup > Feature Tools > Thicken.
3. Select an axis of revolution.
The axis of revolution can be a geometry centerline created as part of the sketched section. The centerline is automatically detected during feature creation. You can also select any existing linear geometry that lies on the sketch plane, such as an axis, or a straight edge or curve to define the axis of revolution.
4. For a first wall, type a value for the wall thickness or accept the default value.
5. Select an option to constrain the angle of revolution and set the angle value or the reference plane.
6. To create a two-sided feature that is constructed on both sides of the sketching plane, perform the following actions:
a. Click Options. The Options tab opens.
b. Select an option to constrain the angle of revolution for Side 1 and Side 2.
c. Set the angle value or the reference plane for each side.
7. To set sheetmetal-specific options, use the Options tab to perform one or more of the following actions:
◦ Click Add bends on sharp edges to round sharp edges when the sketch includes nontangent geometry. Set the value of the radius and the location for dimensioning the radius.
◦ Click Set driving surface opposite sketch plane to flip the driving surface. Use this option when the wall is not a first wall.
◦ Click Merge to model to merge the wall to an existing wall in the design.
To keep the new wall edges from merging with an existing wall, click Keep merged edges.
8. To set feature-specific bend allowance and calculate the developed length using a different method from that of the part, perform the following operations:
a. Click Bend Allowance. The Bend Allowance tab opens.
b. Click Use feature settings.
c. Perform one of the following operations:
▪ Click By K factor or By Y factor and type a new factor value or select one from the list.
▪ To use a bend table to calculate developed length for arcs, click By bend table. Use the default table, select a new one from the list, or click Browse to browse to a different table.
 
* Only bend tables copied to the part are available.
9. Click .